3D Annotations

[papalaz]

Hi all I am back asking for help again,

A customer has sent me a *Catpart file, this is not normally a problem and I can export it as a step easily for use with our CAD/CAM software.

This time the customer has insisted we work from model based definitions and provided not drawings, inside the Catpart file I have shown the 3D annotations and can see all the different views and can see the notes for the file too. But what I am struggling with is exporting this information in a way I can give to the guys on the shop floor to use. Is it possible I can print the different views? I tried using the print command and printing the drawings notes to PDF but the resolution was very poor. Some of my other customers send and SMG file for use with 3Dvia player to view all this information...

Can anyone offer some guidance?

Thanks in advance

 

[m1mason]

In 2D drafting are you able to see the icon View From 3D?
this function will bring in the 3D annotations in an easy to read format and you can
develop your views and sections as intended.

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[papalaz]

Hi thanks for the quick reply, I was kind of looking in the direction you suggested but I am getting the model as a 3D view but not the annotation or when I try and click what I want to make a view from it wont select.

I have posted an image of my screen of the annotations and notes that I want to be able to print off hopefully it might help.

 

[DBezaire]

When you create you drawing file the standards between the FTA and Drafting need to match. Did you get a 3D View Extraction error message that states: It is impossible to generate views when 3D view and the drawing do not use the same standard.......?

Default standard is Iso_3D. Start drafting and modify the standard to iso.

Next, create a view from 3D and select the view in the 3D file under the Annotation section of the tree( I see 5 views in your image, first I can not make out, then ISO, VIEW 1, VIEW 2, VIEW 3)



Win 7
23SP5/24SP3, 3DVIA Composer 2015

 

[DBezaire]

I should add a note to the above, right click/Properties on the Annotations Set in the CATPart to see the standard it was created with.

Regards,
Derek


Win 7
23SP5/24SP3, 3DVIA Composer 2015

 

[papalaz]

Thanks for the help. I had not made the drawing the same as the model, the model was ANSI but the drawing was ISO. I've created the views but I'm not happy with the outcome. Looking at the model under the ISO view I see the model as an ISO view when I insert that they my drawing is rotates the model to a front view but keeps the correct annotation. I'm frustrated to say the least, there is talk of me getting sent on the course but it's 5 days and we are too busy for me to be away that long plus it's too far to drive every day so hotel expense that work don't want to pay etc

 

[DBezaire]

In the options page -

Tools - options -mechanical - Drafting - View.

View from 3D

Keep the following checked.

Keep layout and dress up
Generate 2D geometry.

Uncheck
Generate red cross
synchronize during update.



Win 7
23SP5/24SP3, 3DVIA Composer 2015