3D Cross section Cutting/viewing planes in ProE?

[chassisdeeziner]

In a former life I was a CoCreate user. SolidDesigner had the ability to create cutting planes (essentially a 3D version of a 2D drawing section view). It was terrific for being able to see relationships between parts that are inserted into other parts. Does this sort of capability exist in ProE..if so does anyone know what ProE calls it and what menu it's hidden in?

 

[Tofflemire]

Hi Chassisdeeziner

There are 3 locations that you can find x-sections. There is 1 in part mode, in the menu at the right hand side called X-section (follow the hints on what you want to do).
There is 1 in Assembly mode, in the menu at the right hand side under "setup", X-secton. The final 1 is in drawing mode, in the menu at the right hand side under "views", "modify view", X-section.

Tofflemire

 

[im4cad]

……and you can create as many sections as you want in the 3D models (parts, assemblies), and show them in the drawings too. You can create the section planes first and use them to create your sections, or use datum planes on the fly.

im4cad
Pro Design Services, Inc.

http://www.cadproe.com/pds/home.asp

 

[chassisdeeziner]

Hmmm...OK...that's better. Thanks for the tips.

However Pro doesn't actually remove the portion of the part up to the section plane...instead the section appears as lines that show through the shaded model. I was hoping there was an equivalent way to actually temporarily REMOVE from display the portion of the model up the section plane. Is that possible?

 

[ttx]

Hi,
If I am not mistaken what you want is an assembly cut?
If you create a cut at the assembly level, you can choose which components to include or exclude. This will give you an 'actual' cross section vs. a series of lines on your model that indicate what the drawing cross section will look like.

Hope this helps.

Let me know if you require any further assistance.

cheers,

JW

 

[im4cad]

OK, if you want just something temporarily, there’s something cool for you:
View --> Display Settings --> Visibilities --> move slowly the “Clip%” cursor, and you’ll see something like a dynamic section moving thru your assembly, making possible viewing inside of your assembly


im4cad
Pro Design Services, Inc.

http://www.cadproe.com/pds/home.asp

 

[chassisdeeziner]

im4cad.....BINGO!. That's precisely what I was looking for. The controls are a little clunky...or perhaps I need some practice driving that feature....It's not entirely clear how to get it to cut up to precisely a particular plane.

Nonetheless....that's what I was looking for.

Thanks

 

[im4cad]

That is not for precision, but it's a quick tool to view a sectioned assembly. For an exact section you may want to do asembly cuts as JW said in the previous posting.

im4cad
Pro Design Services, Inc.

http://www.cadproe.com/pds/home.asp

 

[jdsmi]

You can also view just the cross-section lines by hiding the solid or surfaces.

 

[PcCrosby]

I don't know about ProE 2001 but in Wildfire after defining a section in the assembly with "Tools/Model Sectioning..." you can "Right Mouse Click" on the section name and select "Set Visible" the dialog that comes up has a "Clip Front" option, this clips the solid leaving a nice 3D section.

Peter