Adding dimensional variables to a drawing dimension 2

[VELCROW]

Sorry for the obtuse thread subject, but I don't know enough to ask the question properly.

I have a hole with a nearside countersink and a farside counterbore. I can show the callout for the countersink, but in the dimension text, I would like to add the farside cbore diameter and depth. The diameter is D1@Sketch26, and the depth is RD2@Drawing View2.

Is there any way to get these values into the dimension text with <> or anything else?

If not, how would you recommend I dimension this? I don't want to add an entire new view to show the part from the other side, and a section view gets messy also. I can just type in the diameter and depth numbers, but that is pretty bad practice.


Thanks,

Steve

 

[ctopher]

After the Cbore dims, add "far side".

Chris
SolidWorks 09, CATIA V5
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[handleman]

You can create the hole with the hole wizard to include the far side CS. Then, when you add a hole callout, SW will add the far side CS dimensions.

-handleman, CSWP (The new, easy test)

 

[VELCROW]

Thank you, once I get the actual values into the text, I will have to add the diameter symbol, the depth symbol and "far side", but my question is how to get the actual values into the text.

For example, <hw-thruholedia> in the dimension text displays the through hole diameter for the feature attached to the leader. I want a way to display a value from a different feature (the cbore) so I can call out the hole, csink and cbore all in one leader. SolidWorks knows the diameter for the cbore is D1@Sketch26 which equals 0.438, but I want the .438 dimension to show up in the near side callout.

 

[VELCROW]

Thanks handleman, sorry for the crossed posts.

That works, although I need to put the cbore on the far side, and hole wizard only lets me put the csink on the far side. So I changed the sketch plane to the other side, then messed with the dimension text so the far side csink was listed first, then the cbore with "far side" after it.

But I am curious - is there a way to get values from other features into a dimension?

 

[HercalloY]

"But I am curious - is there a way to get values from other features into a dimension?"

Not that i know of. I"ve wanted to do this a few times myself. You can do this for a "note" but not if you're editing another dimensions text "area". Its sucks coz many a time i've wanted to include an array's Qty Number into another dimension so its all nice and parametric.. but SW no can do!

 

[handleman]

The closest you could come to this would be with a linked note that is grouped with a dimension:

1. Create the dimension you want to include in an existing dimension.
2. Create a note in the view containing the existing dimension and link the note to the new dimension.
3. Change the text alignment of the existing dimension to either left or right justified (depending on which side you want the note to go on) so that if the length of the number changes it won't overlap the note.
4. Position the note with linked text the way you want it.
5. Select the note and the dimension, right-click, and choose "group". You can only group items that belong to the same view. If you created your note where it is not actually in the view, "group" will not be available in the right-click menu.

The dimension and note will now move together and appear as the same entity. Both will be parametric.

-handleman, CSWP (The new, easy test)

 

[VELCROW]

handleman,

Sorry to be dense, but I looked in the Help and couldn't see how to

a) link the note to the new dimension
b) embed dimension information (e.g. D1@Sketch26) into a note
c) group a note and dimension (didn't come up when I right click, maybe because I did not link them?)

I am using SW2009 SP3.0

Thanks,

Steve

 

[handleman]

Sorry...

While editing the text of a note, if you click on any existing dimension it will link the note text to that dimension. That will take care of (a) and (b) above.

For (c), you have to make sure that the two items you are trying to group belong to the same view. It is actually pretty easy to inadvertently create your note so that it "belongs" to the sheet and not the view. Once a note is created, you can't just drag it over a view and make it belong to that view. If you have already created a note and it doesn't belong to the correct view, you can give it a leader, then drag the arrow of the leader and attach it to the geometry in a view. That will make the note belong to that view. You can then change it back to a non-leader note and it will still belong to the view.

-handleman, CSWP (The new, easy test)