adding tolerancing to sketch dimensions

[helperug]

My collegues (exSW) want to add tolerances in modelling to the sketches, to reuse this information sketch on the drawing,->feature parameter. I haven't found a way so far - what is the workflow in NX8?

sorry new in NX
regards
Erwin

 

[desgur]

Yes it is possible. Please check the box Use sketch dimension style inside the Feature parameter dialog box. and you will get the tolerances of sketch in drafting.

AK
NX 7.5.3.3

 

[JohnRBaker]

What you do is that while in Sketching, select the Dimensions which you wish to add tolerance information to, press MB3 and select 'Style...' and when the dialog opens you can change the tolerance options in the tab labeled 'Dimensions'.

Now when you create your Drawing and you've placed your views and you wish to inherit the Sketch dimensions on the Drawing, you go to...

Insert -> Dimension -> Feature Parameters...

...and then you select the Feature and Views that you wish to see the dimensions in. One thing that you need to be aware of is if you wish the style of the Dimensions used in the Sketch to controling the style as seen on the Drawing then while in the 'Features Parameters' dialog, you must toggle On the 'Use Sketch Dimension Style' option at the bottom of the dialog.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[helperug]

thank you all,
is there something like a shortcut to get into the Tolerance Value dialog? eq.SW



sorry new in NX
regards
Erwin

 

[JohnRBaker]

You just select the Dimension(s), press MB3 and select 'Style...'

I'm not sure how much shorter that you could make this since that's already down to 3 actions, counting selecting the dimension(s) of interest, which you'd have to do anyway even if there was a single button shortcut, so all you would be saving is ONE interactive 'action'.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.