Assmeblies

[phillpd]

I have a 4-component subassembly.

I add this to a new assembly, geometry link in one of the components and add features to that 'linked' component.

This new assembly is then added to a drawing file (as per master model).

In the drawing file, how do I 'exclude' the un-modified component, but include the 'linked' version of it ?

I could use Layers, or Hide, but that seems messy. Reference sets don't appear to be working well.

Ideas ?



NX 6.0.5.3 (NX 8 Beta)
Windows XP32

 

[desgur]

You must be looking for Edit>View>Hide components in view.



AK
NX 7.5.2.5

 

[mmauldin]

Using "Promote Body" rather than linking geometry automatically blanks out the original component. If you do not need to use other geometry (curves, sketches, etc.) promoting is a cleaner function than linked body.

 

[JohnRBaker]

I suspect that you've just come across one of the those instances where creating a 'Promotion' instead of a 'WAVE' linked body would have been the better solution.

Generally speaking, if your intention is that the 'linked' body will in fact 'replace' the original parent component in your working assembly, then using a Promotion will give you what you want. WAVE linking is intended to be used where you want one component to be derived from another, but not always as a replacement. For example, I model the left-hand version of a part and WAVE link a mirrored body for the right-hand version. In this case you would probably NOT be using the right-handed version as a substitute for the left-handed component. However, lets say that you're creating a model which will be modified once it was part of an assembly, perhaps adding some holes which are going to be drilled on the shop floor to align with some other component. Due to tolerances or even how something else was positioned, there was no way to define these holes while the part was being manufactured so assembling the component, Promoting it and then at the assembly level adding the holes will allow you to duplicate the actual workflow that you would have in the physical world. You need the holes, but ONLY at the assembly level, not when the piece part was being manufactured.

Note promotions are also useful in the workflow where you might start with a part that was modeled as cast/forged and then each level of Promotion would be used to model in the secondary manufacturing operations, such as facing off the part, adding drilled holes (maybe even some threaded-holes), adding other details which will be machined into the part.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

To an Engineer, the glass is twice as big as it needs to be.

 

[phillpd]

Thanks guys, just tried with a Promotion (once I'd enabled it) and that worked perfectly.

NX 6.0.5.3 (NX 8 Beta)
Windows XP32