Breaking Configurations Into Seperate Parts 2

[Kjford]

Hello,

I am currently working on a contract to update a clients older drawings with a new part numbering system in Solidworks 2010. In order to link properly in the new PLM system the .sldprts have to match up with the new part numbers.

The problem that I have run into is that some of the assemblies used configurations that now have to be separate parts. The configurations have their own complete drawings, and I don't want to have to completely redo the drawings.

Is there a way to save a configuration as a new part? Or is there a way to link a drawing to a new part without deleting all of the previous dimensions/views? Or am I pretty much stuck redoing the drawings?

 

[tristram]

You should be able to do a Pack-n-go on the parts and drawing (changing the file names) and then delete configurations not being used. That will keep the links between the new parts and new drawings.

-Joe
SolidWorks 2009 x64 SP 5.1 on Windows XP x64
8 GB RAM - Nvidia Quadro FX1700

 

[ShaggyPE]

ConfigRipper

http://sw.fcsuper.com/index.php?name=UpDownload&req=viewsdownload&sid=5

This is a macro on Matt Lorono's site (fcsuper).

-Dustin
Professional Engineer
Pretty good with SolidWorks

 

[ShaggyPE]

After you rip the configs into separate files. Start to open each drawing and change the references associated with the drawing file.

Its in the "open" dialog box. There is a button marked "references." Click on that and then browse for the newly created part file.

-Dustin
Professional Engineer
Pretty good with SolidWorks

 

[Kjford]

Thanks guys, with your help I was able to get the job done much quicker than if I had to redo the drawings.