Can Catia make a component referece on a drawing?

[Runz]

Is it possible to show a component in a drawing view as a refernce, where by you can see all geometry behind the reference component as though it was not there. We are creating assembly drawings of our products and would like to show the customers interface components as a reference. We still need to see what is behind their interface components on our drawings. We don't want to show hidden lines. In other CAD packages such as Inventor (You made these component models "Reference") and in Pro/E (Exclude and make Transparent).
Does Catia have this functionality???
Thanks

 

[DBezaire]

Runz,
Under the management tab on the property page of the part there is an option called Represented with Hidden lines. Will this work?

You could also incorporate this using a scene. While in the scene you can change the part colour to a particular colour.

Regards,
Derek

 

[KevinDeSmet]

Right-click on your view and look for a command called "Overload Properties". Might be what you're after.

Certified SolidWorks Professional

 

[Runz]

Overload Properties does not contain any functionality that will accomplish what I am looking to do. As far as I can tell, Catia is unable to do what I am trying to accomplish.
Again, I want to show a part as Reference with phantom lines. The view will be shown as though the reference component where not there. Any components behind the reference component would be shown as solid geometry, as they would appear if the reference component were not part of the drawing view.

 

[jopal]

I've asked this same question, and was told it can't be done. A work around may be to create your view so the phantom geometry you want is actually displayed, duplicate the geometry and change the line work to phantom lines, then move your view accordingly.

 

[Azrael]

Runz, as KevinDeSmet said in overload properties on the views you can control how the part should look and behave, you can control graphic properties and view behavior. What DBezaire suggest is a subset of these setting (only view behaviors) that can be set from the assembly (right click on the instance->properties and then drafting tab).

If I understood you right you have to use the overload properties and change the graphical properties to phantom line for those dedicated parts. If I got it wrong then a picture could be helpful to understand better

Jopal, you would be suprised how many things that "can't be done" actually can

 

[Azrael]

One thing to add... when using overload properties... you actually have to pick the parts in the drawing view that you want to control and in the window chose which part and edit to actually get to the part that is interesting....

Don't know if you already knew this.. but this part was a little tricky for me first time using overload properties

 

[Runz]

Again, overload properties can't accomplish the described task. It will definitely change the required referenced component line type to phantom, but again, will not show what is behind the the reference component...it only changes the line type of the component in the drawing view. The settings within the overload properties are "Cut in Section", "Use when projecting", "Represented with Hidden Lines" and "Shown". None of which will show the graphics behind the component.
The only way I have found to accomplish this is to create a separate view of the component that is to be reference, change its line type and then superpose (View positioning) it over the other view.

 

[Azrael]

If you use both methods, in the assembly right click on the instance->properties and then drafting tab, there is an option that doesn't exist in the overload properties, hidden lines, this will set all hidden lines of the part as phantom but visible lines will be solid, if you then also add overload properties and change the graphic to phantom you will see the full part as phantom.

The other way is to set up two views using same projection plane, one for the real parts and another view for the reference geometry that you set to be shown as phantom, then superpose then to get wanted result.

 

[Runz]

Azrael...maybe I am missing something, but "Represented with Hidden Lines" is available from the overload properties??? I do no see any option within the assembly properties which is not available in overload properties. Could you give more detail. Again, if the component which is the reference component is the top component in the drawing view, can you see all other geometry behind the reference componets as solid? It should apear as the top (Reference) component is transparent.
thanks,

 

[jackk]

Runz, could you attach a picture showing exactly what you're trying to achieve

 

[Azrael]

Sorry for the late answer, had some issues to solve... you are right about the hidden lines, noticed when I double checked that it is available there also. I think I need visual aid to understand your issue better, could you attach a picture showing the 3d and one showing the dwg... and what you want to achieve?