CATPart structure 2

[CAD2015]

Happy Friday!

Please, have a look below, at the tree of the two CATParts.
The color of the Bodys in the left are gray (do not know what that means....).
I need to meet the company's standards, which requires to use hybrid design only (see the CATPart located on the right).
I want to modify the left CATPart to have its Bodies looking identical with those shown on the right picture.
What other option I'd have to do this?
I could remodel the original math data into the file on the right, copying the sketch and creating a new model and then Saving As.
But I was wondering if there is something faster, which also, would allow me to keep the original file.
Anticipated thanks!

CAD 2015

 

[MarkAF]

I think if you search the forum you'll find a lot of information about this.

Summary of the icons: The grey gear icon means the body is non-hybrid but your Catia setting is set to hybrid mode. The green gear icon means the part body is the same mode as the Catia settings. A yellow body means it is a hybrid body but your Catia setting is set to non-hybrid mode.

Interestingly, it is possible to have a mix of hybrid and non-hybrid bodies in a part. This is determined by each body individually.

To update this part, I think you could simply add a new body to your part model. Copy the elements from Body.2 into the new body. You may need to use "Paste Special / As Specified". Once that is completed, set your new body as the 'PartBody' object, and delete the other two bodies.

For this case, I would bet it's pretty simple. Normally if a company has a rule about hybrid bodies, the rule is never use them. It's much more difficult to turn a hybrid-body part into non-hybrid...but I think this would be pretty easy. That said, I've never had a reason to try it. Also, I don't know if mixing in sheet metal features will make any difference, but I'm guessing no.

Hope that helps,
Mark

 

[itsmyjob]

did you try to make a file using new from?

Will that turn the non-hybrid bodies into system defined hybrid bodies?

Let us know

Eric N.
indocti discant et ament meminisse periti ​

 

[CAD2015]

Thanks a lot, Mark!

CAD 2015

 

[CAD2015]

I'll try that, Itsmyjob.
Thank you so much!

CAD 2015

 

[CAD2015]

Mark,

[highlight #EF2929]"To update this part, I think you could simply add a new body to your part model. Copy the elements from Body.2 into the new body. You may need to use "Paste Special / As Specified". Once that is completed, set your new body as the 'PartBody' object, and delete the other two bodies".[/highlight]

The problem is that the "container" (the system created PartBody can't be deleted; it'll stay "gray" and I do not want that.
Is there any way to update the original PartBody from grey to green?

CAD 2015

 

[CAD2015]

For everybody:

"- Did you try to make a file using new from?
Will that turn the non-hybrid bodies into system defined hybrid bodies?
Let us know!"
Itsmyjob

I tried to make a file using "New from".
It would keep the same behavior, so this is not o solution.

CAD 2015

 

[itsmyjob]

thanks for feedback...

to remove the partbody:

create another new body (it should be green) then select the option (under right click) to make it the partbody.

Then remove the old grey ex-partbody

Eric N.
indocti discant et ament meminisse periti ​

 

[CAD2015]

Finally, I just create a new file and overwritten the previous one in TCe.
In this way, I saved all the links of the original file.
Thanks you all for assistance and consideration.

HAPPY FOOLS DAY!

CAD 2015

 

[CAD2015]

Itsmyjob:

Eureka!

Your last tip works just fine!..................
Great reply!

CAD 2015