Copy and Paste 2

[IEngr]

hi,
I am working in NX8.5. Consider a part named A and another part named B. In Part A, i have some extracted points. I copy those points and paste with link in Part B. But when I go to the information of the pasted points, the point is said to be of Part B instead of A. Can we copy paste points with link and in information also show its parent?

Thanks and Regards,
Isha

 

[NutAce]

Wave linking would be your best option....

Ronald van den Broek
Senior Application Engineer
Winterthur Gas & Diesel Ltd
NX9 / TC10.1.2
HPZ420 Intel(R) Xeon(R) CPU E5-1620 0 @ 3.60GHz, 32 Gb Win7 64B
Nvidea Quadro4000 2048MB DDR5

HP Zbook15
Intel(R) Core(TM) i7-4800MQ
CPU @ 2.70 GHz Win7 64b
Nvidia K1100M 2048 MB DDR5

 

[Toost]

You ask for a link,
Copy paste is (most often) not a link.
The wave feature is.

The points in part B will be dependent of the points in part A, if you move the points in A, the points in B will update ( as long as both parts are open in the same NX session.)

Regards,
Tomas

 

[IEngr]

Wave linking is not possible between two different parts. Both has to be in same assembly. So when we do copy paste with link, it works for all features except points. So wanted to know how to do copy paste with link for points other than wave geometry link.

 

[JohnRBaker]

They ONLY have to be part of the same Assembly at the moment that the links are being created. Once the link is established the Assembly can be deleted and the links will remain intact and active.

John R. Baker, P.E. (ret)
EX-Product 'Evangelist'
Irvine, CA
Siemens PLM:
UG/NX Museum:

The secret of life is not finding someone to live with
It's finding someone you can't live without

 

[IEngr]

oh.. I will try that. Thanks John

 

[IEngr]

I tried as you said John. Its working fine. But when I go to the information of that feature, It says the assembly name and is unloaded, even if I have deleted the assembly. Is there any option to not show the assembly information?

 

[Lockdain]

Hello!

Let me offer a different way to obtain WAVE-link without an assembly. It's only recommended to load both (original and target) parts in the one session.

1. Right click in the Assembly navigator and make sure that WAVE-mode is on.

2. Then right-click on the part you wish to make a new link from and choose WAVE - Copy Geometry To Part as it shown below:

3. Next window will show you all parts available in the current session (but you'd be able to choose the part file also from your file system or TC environment). Choose a part you want to copy a link to:

4. Select a needed geometry for WAVE-link:

The result feature is shown below

 

[IEngr]

Thanks Lockdain.. But we dont have wave license. So can't try it.I will definitely try this once we get the license for it.

Isha
Mechanical Engineer