Diameter dimension 4

[aer73]

Hello to all.
How can put a diameter dimension like the image, the arrow on one side only?
Thanks to all.
Best regards.

 

[ArtL]

AER73 - Because the left side of the chamfer isn't there,I would dimension - 90deg X 2mm(guess) depth. If you can't measure it, you shouldn't dimension it. It's really easier for the shop to correctly make the part then.In Version11 you can use the chamfer dimension directly on the 45 deg angle.

 

[Updraft]

AER73,

In answer to your direct question I do not know how to make the dimension display as you want. However, you might try just using a note.

ArtL, you are correct that if you can't measure it you shouldn't dimension to it. However, I'll bet that this feature is only incomplete in this section and that its diameter is complete in a perpendicular view. AER73, you might consider showing the perpendicular view so the dimension would show without confusion.

- - -Updraft

 

[CorBlimeyLimey]

The depth would be a better dimension to use anyway.

 

[handleman]

1. Using a sketched centerline (not the centerline tool), sketch in a centerline and constrain it to be symmetric with the two edges of the thru hole.
2. Activate the dimension tool and pick on the spot where you want the dimension attached.
3. Click on the centerline you created.
4. Pull the dimension off to the left of the centerline before placing it. It will turn into a diameter dimension. Place the dimension.
5. RMB on the witness line you don't want to show and click "hide witness line". RMB on the dimension line near the arrow you don't want to show and click "hide dimension line.

-handleman, CSWP (The new, easy test)

 

[aer73]

Thanks for the answers, but the answer of Handleman is what i need for to that.
Thanks to all.
Best regards.