Drawing View Creation

[PromptCAD]

Can anyone help?

I have created a casting model which has both draft and fillet radii.
When producing a drawing from the model the views are not how I would like them to appear.
please refer to the attachment to relate the following comments.
View 1. 'Tangent Edges Visible' This gives a view that is far to congested.
View 2. 'Tangent Edges with Font' This highlights that some lines are solid edges and some tangent edges.
View 3. 'Tangent Edges Removed' This shows only part of the Double Boss feature I am trying to show.

My question is :- Can I select any tangent edges and change them to solid edges? or is there some other way to achieve a clear drawing view?

Thanking you in advance

 

[handleman]

That's a tough drawing to make. Yes, I'm pretty sure you can select any edge/edges (tangent edges included) and change its line font individually. Just enable the Line Format toolbar.

-handleman, CSWP (The new, easy test)

 

[macduff]

I've done many complex castings in the past and the drawing view you want the one with "Tangent Edges Removed". Try and turn on the sketch (in the view) that makes up the extruded boss, and then select the geometry, then Convert Entities. This project geometry from the solid and still maintains associativity.

Colin Fitzpatrick (aka Macduff)
Mechanical Designer
Solidworks 2008 SP 4.0
Dell 490 XP Pro SP 2
Xeon CPU 3.00 GHz 3.00 GB of RAM
nVida Quadro FX 3450 512 MB
3D Connexion-SpaceExplorer

 

[hendersdc]

I have had to deal with the same kind of problem with injection molded parts. In the drawing right click on the view you want to modify and go to "Hide Edges" or "Show Edges". Within these you can hide or show which ever edges you want in that view.

 

[bsj0526]

I too have dealt with a lot of die cast and injection molded part drawings, and sometimes the best way to deal with them are to create extra features or sketches that you can reference in the drawing.

-Brian

 

[PromptCAD]

Thanks for your replies to my question.

I have been evaluating the best solution for us. The following is, at present, we feel the best.
Again I have attached a file to show views of how we resolved the problem. I hope it helps others that may come across the same.

We have 2 configurations in the Model 'Default' and 'Fillets Removed'.

1. 'Default' - Shows all fillets and radii unsuppressed.
2. 'Fillets Removed' - Shows some of the R1 and R3 fillets suppressed.

The drawing orthogonal views are created using the 'Fillets Removed Configuration'. Where as the isometric view uses the 'Default' Configuration. The orthogonal views now have the desired representation.
A note '6' has been added to the drawing to explain the removal of the fillets.

The casting manufacturer can use the Model with 'Default' Configuration to produce the Die.

 

[macduff]

Prefect! That's the way I would've done the bottom right-hand view for the drawing.

Colin Fitzpatrick (aka Macduff)
Mechanical Designer
Solidworks 2008 SP 4.0
Dell 490 XP Pro SP 2
Xeon CPU 3.00 GHz 3.00 GB of RAM
nVida Quadro FX 3450 512 MB
3D Connexion-SpaceExplorer