Edit line in break-out section

[cubalibre000]

Hi,
I created a break-out section with the sketch tool in the specification.
My threaded hole is not completely visible, so I want to move my line.
In the edit break-out section mode I can't move my lines.
It's possible ?

Thank you...

Using NX 7.0.1.7 MP3 and TC8.1

 

[JHTH]

Hi again,

The only way I have found is to delete the section, then move your sketch curves and then create a new break out section.

To do this, start the Break-out command, change the button at the top to Delete, untick Delete Break Curves and Ok. This leaves your sketch, which you can move, and then create a new break out section the same as before.

Cheers,

JH

JHTH
NX 7.0.1.7 + TC 2007

 

[jerry1423]

Here's how to do it in NX6

Insert > view > break-out section view > edit (on top) > select boundry curves > modify boundry curves (right icon) > move the end points (stretch) of the boundry curves

 

[cubalibre000]

Hi jerry1423,
NX7 has a different method to create break-out section view.
You use sketch tools in the view.

Thank you...

Using NX 7.0.1.7 MP3 and TC8.1

 

[cubalibre000]

Hi,
the solution is :
1) Change the visualization without the timestamp in the part navigator.

2) Now we are able to visualize/edit sketch entities.

3) Activate the sketch if not just active.

4) Visualize lines/curve in the sketch profile sketch.

5) Edit entities using drag&drop method if not constrained or edit constraints, but don't delete or add anything.

6) Update the view.


If we want to change to much the profile it's better to create a new profile in the same view and then Insert > View > break-out Section View > Edit mode> select the old profile, click on the icon Select Boundary Curves to redefine the profile (select the new entities set).

At the end, the old entities can be deleted.

Thank you...

Using NX 7.0.1.7 MP3 and TC8.1

 

[JHTH]

That's a good way to do it, thanks!

JH