editing an assembly, bug???

[Scarecrow]

Hi Gang,
using SW 2003. Here's the scoop
I have a multipart assembly with sub assemblies embedded within. I have punched thru a few holes from the top assembly drawing on to a part. The part shows the holes in the sub assembly, but when i open the part my holes do not show up. Ummmm what am i doing wrong here. I need to edit from within the assembly because the holes i punched thru my part use geometry from another part within the assembly.

Hope that's not too confusing.

Thanks

Gerry

 

[dutch7777]

Thats called an assembly feature...like a weld operation.It doesn't migrate back to the part file. What you need to do is "edit part" while in the assembly then copy geometry
or use convert edge. Be careful tho as this creates
references between the two parts which can bite ya
sometimes unless it's your "design intent" for it to work
that way...they can be deleted tho...

 

[MadMango]

Use Hole Series to see your hole thru all parts. Ray Reynolds
Senior Designer
Read: faq731-376
"Probable impossibilities are to be preferred to improbable possibilities."

 

[macPT]

Scarecrow

What is your design intent?
If the assembly as to be drilled "in the real world", than the components does not have any hole before the assembly (and they shouldn't have it). That's why you open the parts and there's no hole.

If the parts or subassemblies have to be drilled before assembly, than you can't drill them in the assembly. You must drill them before. That means that you need to go to each component or subassembly and perform this feature.

Regards

 

[MadMango]

Keeping Design Intent in mind, if you watch to match drill a hole thru various features, your best option is to use Hole Wizard>Hole Series. This will create the hole in all non-suppressed parts in your assembly. Ray Reynolds
Senior Designer
Read: faq731-376
"Probable impossibilities are to be preferred to improbable possibilities."

 

[Scarecrow]

thanks all for the help.
I must have doen something wrong, because second time around while editing the part in the top assembly I was able to keep the holes in the base part file.
I did learn something new though: hole series, that's one I have not used before, and I can certainly see the benefits.

So with that in mind, my design intent should be.....
assemble the parts together, then punch my hole thru those that are not suppressed? This is way easier than convert entities on each part, especially if there are quiet a few that use a common mounting hole ya?

This is a great resource!!!!

Gerry

http://www.scatmat.com