Hole Table 2

[designer22]

I was trying to create a hole table for one of the job and noticed the call out something weired.

The counter bores are far side of the view, but the call out showing Near Side.
How can I make it to show "Far side" in the Call Out?

Thanks

 

[ctopher]

It indicates the counter-bores, but does not indicate which side. It only indicates countersinks near side.
I suggest changing the view to the other side showing the counter-bores.
The "mid side" is new to me.

Chris
SolidWorks 10 SP4.0
ctopher's home
SolidWorks Legion

 

[fcsuper]

Too...many...problems...to...computer! 1) Non-capital letters, 2) The drawing view itself is on the wrong side (all the c'bores are facing the other way), 3) two coordinate origins? 4) "Mid side" is not a specification, you main "FAR SIDE" in the current view, or if you turn the drawing around "NEAR SIDE" 5) no such thing as "THRU ALL" in the ASME standards. All dims (dia included) are considered as thru, but if you want to say something, just as "THRU" 6) OK, that's it for now.

Matt Lorono
Lorono's SolidWorks Resources & SolidWorks Legion

http://groups.yahoo.com/group/solidworks & http://twitter.com/fcsuper

 

[SteveMartin]

Per fcsuper's #3: that's not two origins, just one badly displayed one. SW hole table does not make a good origin indicator by default.

I have a separate comment on the origin though: why put the origin at an empty point? I assume that it's the center of the part, but are you really intending to make the machinist (and inspection) locate center and then find holes off that theoretical point?

 

[designer22]

This hole table is generated by SW2010 SP4.

Matt,
This is part of an Ejector Retainer Plate of a Mold Design.
It is the proper plan view of the mold. If I turn the drawing around,it will give the counter-bore holes visible,but will give wrong co-ordinates in relation to the main mold parts.

Steve,
I agree with origin indicator, (SW's default origin is not very good).In this example I just give middle of the block as origin.
My question is, why SW give "Near Side" in the call out?
(Except the thru hole, none of the features are on the "Near Side" as it is viewed, It is a counter-bore hole with chamfer.)
Is it possible to add a property to the table like "TYPE"? For ex: C/Bore 1/4" DME Pin or C/Bore M8 SHCS

Does this need an Enhancement?

Thanks,

 

[Updraft]

designer22,

Near/Far side reference is with respect to the surface you pick for drilling/boring the hole. It is really only relevant for thru holes, i.e., there is no far side for a blind hole. The near/far side reference has nothing to do with the view it is shown on.

It is bad drafting practice to dimension to hidden lines. It would be better to give another view looking into the holes.

When you select the hole table you have the option to pick reference edges to define the origin for the table. Most conventions use the upper left corner of the block in the view looking directly at the surface that gets drilled. Better than this is to use the same reference corner as the mill that will machine the holes, if you happen to have that information.

Yes, you can modify a callout to add your custom text. I would recommend you keep this at a minimum. SolidWorks has done a superb job of automatically using the appropriate industry standard notes. Pay attention to the warning you get from SolidWorks when you start to modify such annotations.

The purpose of a drawing is to clearly communicate the requirements of the part. If multiple views keep the confusion down then use them. The last thing you want is to get into an argument that the drawing is "correct" when you have an unusable part that was made from it. With the ease we have to make accurate drawings with clear details, sections and annotations there are more tools than ever to make sure the fabricator understands what is expected.

- - -Updraft