LEARNING NX - PART LIST

[Javiduc]

Hello,

I am a user of Solidedge and I would like to learn NX. I have created some assemblies, parts and drawings in order to practice with the tools and commands, but I am unable to create a part list in a drawing. When I insert a part list, I can only see the headers, but no parts are showed. In the options I click on associate with the view, but it makes nothing. I suppose I am making a very simple mistake but I can't find what it is. Can anyone please help me? Thank you very much in advance.

Best regards
Javier

 

[NutAce]

How did you create your assemblies? Can you post a picture of your assembly navigator with the structure loaded? (drawing included)
What version of NX do you use?

Ronald van den Broek
Senior Application Engineer
Winterthur Gas & Diesel Ltd
NX9 / TC10.1.2
HPZ420 Intel(R) Xeon(R) CPU E5-1620 0 @ 3.60GHz, 32 Gb Win7 64B
Nvidea Quadro4000 2048MB DDR5

HP Zbook15
Intel(R) Core(TM) i7-4800MQ
CPU @ 2.70 GHz Win7 64b
Nvidia K1100M 2048 MB DDR5

 

[Javiduc]

Thank you for your answer.

I created the assemblie by clicking in new button to créate the assembly and then in add button to créate parts (I am not sure if this is the correct translation from Spanish).
I use NX10.
I have learned something new about it, I can see all the ítems in the part list if open drawing environment inside the assembly file but if I create a new empty drawing in a different file, and then insert a view of the previous assembly, when I create the part list I can only see the headers.
These are the pictures I think you asked about

Javier

 

[cowski]

You don't have a true assembly; you have added drawing views from the individual components, not the components themselves. To really add a component, switch to the modeling application -> assemblies -> add and choose a part file to add as a component.

www.nxjournaling.com

 

[Javiduc]

Thank you for your answer.

I think I have a true assembly. In the drawing file i have inserted just one view of assembly1.prt with is a 3D file which contains links to model1.prt and model2.prt.
If I create a partlist inside the assembly1.prt I can see all the items, but if create a new part and then, I place in it a view of the assembly1.prt then I can see items in the part list as we can see in the pictures attached. Maybe, I don't understand something you are trying to explain. Sorry I am not at home now and I can't attach any more pictures.

 

[NutAce]

Can you upload your pictures ? I can't see them..

Ronald van den Broek
Senior Application Engineer
Winterthur Gas & Diesel Ltd
NX9 / TC10.1.2
HPZ420 Intel(R) Xeon(R) CPU E5-1620 0 @ 3.60GHz, 32 Gb Win7 64B
Nvidea Quadro4000 2048MB DDR5

HP Zbook15
Intel(R) Core(TM) i7-4800MQ
CPU @ 2.70 GHz Win7 64b
Nvidia K1100M 2048 MB DDR5

 

[NutAce]

Found a way to view the pictures..

When you look at your assembly structure of your drawing you see this purple book icon behind assembly1...
This happens when you add a view from a component, in this case the assembly1 is the component of the Dwg1.
This Book icon is telling you the component is added as reference only...which means the drawing doesn't have any components for the partslist...
Rightclick on the assembly 1 and select properties...there you will find a checkmark on "for reference only"...remove this and now your partslist should work...

Keep in mind....the correct way of adding an part (or assembly) to a drawing can be done in 2 ways...

[ol 1]
[li]With the part (or assembly) openend, select file new to create the drawing...NX will automatically select the part (or assembly) as it's component.[/li]
[li]When creating a drawing without a part (or assembly) open select your part in the file new drawing menu in the "reference part" section[/li]
[li]When creating a drawing without a part (or assembly) open, add the component for the drawing with (from assemblies toolbar) Add Component[/li]
[/ol]

Ronald van den Broek
Senior Application Engineer
Winterthur Gas & Diesel Ltd
NX9 / TC10.1.2
HPZ420 Intel(R) Xeon(R) CPU E5-1620 0 @ 3.60GHz, 32 Gb Win7 64B
Nvidea Quadro4000 2048MB DDR5

HP Zbook15
Intel(R) Core(TM) i7-4800MQ
CPU @ 2.70 GHz Win7 64b
Nvidia K1100M 2048 MB DDR5

 

[cowski]

Your "assembly1" may be a true assembly; however, in the "dwg1" file you have only added a drawing view from the assembly. As a result, you only currently have "drafting components" in the "dwg1" file (indicated by the 'yellow cube on top of a drawing titleblock' icon in the assembly navigator). Drafting components do not participate in a parts list.

Delete the current drawing views and the drafting components in the assembly navigator will disappear. Switch to the modeling application and make sure the "assemblies" application is activated. Now add "assembly1" as a component to the "dwg1" file (assemblies -> add -> choose the "assembly1" file). At this point you will see the assembly in the modeling application; if you switch to modeling in your current file, it will be empty (drafting components do not show up in modeling). Switch back to drafting and add the views that you want; the parts list should work now (you may have to fiddle with the "levels" option to get exactly what you want to appear in the parts list).

If you are using native NX (not connected to Teamcenter or other PDM/PLM), you may not have the "for reference only" option mentioned by nutace.

www.nxjournaling.com

 

[Javiduc]

Thank you very much to you both. Now, I can see all items of the part list on the drawing file.