Modify Drawing 'standard 3-views' 1

[rokahn]

How to change view in standard 3-view drawing. It puts in Front, Top, and Right views but some parts would be better served with Front, Back, and Right views. I can delete the Top view and substitute a Named view (Back) but this view is no longer 'aligned' with the Front view (in that it's not horizontal to the Front view). Any better way of doing it?

On a similar vein, if I insert an isometric view but want it from the other side (or a different rotation than std isometric), how do I insert a "custom" view?

 

[SBaugh]

Rok,

You can't change the standard 3 views to my knowledge. If you want more than what views you have, you need to simply click Insert \Drawing view\Named view and pick it out of the Property Manager (PM) the view you want to add. Once you get the view in place on the drawing somewhere. You need to RMB the view and click Alignment\ Then pick the most suitable choice that fits your needs. I 95% of the time use Origin vs. Center.

You need to make a custom view in the model that you want. Once you get the model in place you need click the space bar and view orientation pops up. Click the first telescope from your left and type in a new name. Then go to the Drawing view and insert it like I stated above. Or if you already have your ISO view in place. Click on the view and in the PM you will see all your views (View Orientation) simply Double Click the appropriate view.

I think that will get you through...That will $40 bucks now ... j/k

Cheers,
Scott Scott Baugh, CSWP
credence69@REMOVEhotmail.com

http://www.3dmca.com

http://home.insightbb.com/~scott.baugh/

*When in doubt always check the help*

 

[manxJim]

What you need to use is Projected view go to insert /drawing view /projected then click on any view then move the mouse up, down, left or right to get the new view that you want. I create all my drawings in this way
Hope this helps
Jim

 

[APPENG]

Actually the way to switch the views around is to go back to your model and use the standard view toolbar to show a standard view lets use the following scenrio:

MOdel in drawing top view shows the front instead.

Go to the model select the front view from your standard view toolbar.

hit the space bar to show the view orientation dialog box.

Click on "top" then click the update view button (middle button up top)

a message box will come up saying that you are changing the standard view. click OK.

cycle throught the standard views in the model file and verify that top is top, right is right, and front is front... if ont make adjustments as necessary.

Thats it.
Regards,
Jon
jgbena@yahoo.com

 

[BBJT]

I think the issue, if I am not mistaken, is being able to create 3 views automatically that does not consist of the standard front, top, and right view. It is not possible, in the current realese of SW, at his time. That is out of the box it is not anyway. BBJT CSWP

 

[APPENG]

After reading the original question again, you can insert individual drawing views such as back, front, and right separately. The need for alignment is address simply by aligning the views. If you right mouse on drawing view, and select "align verical by origin", or "align horizontal by origin" and then select the view that you wish to align it with, you can make them stay aligned as if they were created as projections.

Example:

If you have a front view and a side view next to it. you would right click on the side view, select align horizontal by origin, and then click anywhere on the front view.

To create a new isometeric view, just rotate the part to the desired perspective, Then do as Sbaugh has suggested and create the new view.

Hit the spacebar, click on the "telescope" on the left (new view icon) type in the name i.e. "ISO2" click OK

Now in your drawing, you can select ISO2 from the list as you would with any other named view that you would pace in a drawing. Regards,
Jon
jgbena@yahoo.com

 

[TateJ]

As far as I know, the only "control" you have - other than what's already been covered - is to toggle the type of view projection from FIRST ANGLE to THIRD ANGLE.
Start a drawing, then RMB somewhere on the drawing and select PROPERTIES.
You can save this in your FORMAT if you like.
This won't get you exactly what you want - it's just another 2 cents worth... "Hokey religions and ancient weapons are no match for a good blaster at your side." Han Solo

 

[rokahn]

APPENG and SBaugh's advice was useful for replacing views with other standard views and aligning them.

I didn't understand how to place custom rotations of views in the drawings until I tried rotating it in the 'PART view' and then, back in the drawing, inserted a named view with "current model view". This worked well.

However, I've been unable to change view orientation using the space bar. When I try to change orientation, I see only one option "*Full Sheet". When I 'add new view' such as "ISO2", it doesn't appear in the 'named views' nor can I convert other drawings to that view using the orientation dialog. This is not a major problem so thanks for the help.

 

[MadMango]

You need to change your View Orientation in the Part model file. Once that is done, then you can insert your "new" standard views in the Drawing file. "The attempt and not the deed confounds us."