NX9 Feature Parameters

[MattBaumann]

We are finally upgrading to NX9 from NX5 and I'm looking to help our productivity when it comes to Drafting. We currently manually enter in most of our information for hole callouts. I noticed the Feature Parameter option, but I can never get it to work correctly. I would like it to automatically give me:

Count, Hole Diameter, Hole Depth
Thread x Pitch, Depth

as in

12X <o>3.0 THRU
M3.5 x 0.6

It currently gives me two separate leaders to each line. Can I combine these somehow?

Thanks,

Matt

 

[MattBaumann]

The first attachment is what I am looking for. Here is what it currently gives me (see attachment).

 

[JohnRBaker]

In you're running NX 9.0, at least for hole callouts, don't use the old Feature Parameters. When you're ready to add your hole callouts to you Drawing, to the 'Dimension' section of the Drafting 'Home' ribbon and select the 'Radial' dimension icon. When the dialog comes up, go to the 'Measurement -> Method' and change it to 'Hole Callout' and then simply select the holes that you wish to annotate. Note that only time the system will automatically give a total number of like holes will be if the mutiple holes were created using the Pattern Feature function. Note that if you don't want or need all of the symbolic and dimensional information displayed with the Callout you can eitehr edit them by selecting the callout, pressing MB3 and select the 'Settings' option and then under the 'Hole Callout' item you can toggle ON/OFF the items of interest in the callout. If you would like to set-up these setting as your standard you can do that by going to Customer Defaults and selecting your particular standard the can be preset under the 'General -> Hole Callout' item. Note that this is a 'Part' setting which means that it will not affect existing Drawings (or any predefined templates) files. For existing files you'll need to make these changes and then make sure that the drawing has been changed to point to the standard that you want to use.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[MattBaumann]

Perfect, that's exactly what I was looking for. Thanks John.

Matt