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NX9 - Journal code to toggle edges hidden by edges 1

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Kenja824

Kenja824

Automotive
Joined
Nov 5, 2014
Messages
958
Location
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To be clear from the start, this is for views already created. I need to create a button that will automatically select all views on a sheet and toggle "edges hidden by edges" on and off.

The reason I need this is because when they are left on, too often hidden hole diameters will look almost solid because it is showing the edge of both sides of the hole and the dashes do not line up. Yet, we need to turn them on while selecting the side view of a hole to place the origin of an ordinate dimension. Which we do a lot. Too often people will add the dims but never turn the edges hidden by edges off again and the prints end up making some hidden lines look solid. It would make it much easier for people to just select a button to turn this option on and off for all views on a sheet.

Any help with this would be appreciated.

Thanks
 
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Anyone? ........ Anyone? ..... Bueller?
 
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Below is the journal code in VB. Tested on NX 10.0.3.5

Code: 
Option Strict Off

Imports System
Imports System.IO
Imports System.Windows.Forms
Imports System.Collections.Generic

Imports System.Drawing

Imports NXOpen
Imports NXOpen.UF
Imports NXOpen.Utilities

Imports System.Environment
Imports NXOpenUI
Imports NXOpen.Annotations
Imports NXOpen.Drawings




<Global.Microsoft.VisualBasic.CompilerServices.DesignerGenerated()> _
Partial Class Form1
    Inherits System.Windows.Forms.Form

    'Form overrides dispose to clean up the component list.
    <System.Diagnostics.DebuggerNonUserCode()> _
    Protected Overrides Sub Dispose(ByVal disposing As Boolean)
        Try
            If disposing AndAlso components IsNot Nothing Then
                components.Dispose()
            End If
        Finally
            MyBase.Dispose(disposing)
        End Try
    End Sub
    Public theStatus As Boolean
    Friend WithEvents ButtonON As System.Windows.Forms.Button
    Friend WithEvents ButtonOFF As System.Windows.Forms.Button

    'Required by the Windows Form Designer
    Private components As System.ComponentModel.IContainer

    'NOTE: The following procedure is required by the Windows Form Designer
    'It can be modified using the Windows Form Designer.  
    'Do not modify it using the code editor.
    <System.Diagnostics.DebuggerStepThrough()> _
    Private Sub InitializeComponent()
        Me.Button1 = New System.Windows.Forms.Button()
        Me.ButtonON = New System.Windows.Forms.Button()
        Me.ButtonOFF = New System.Windows.Forms.Button()
        Me.SuspendLayout()
        '
        'Button1
        '
        Me.Button1.DialogResult = System.Windows.Forms.DialogResult.Cancel
        Me.Button1.Location = New System.Drawing.Point(54, 96)
        Me.Button1.Margin = New System.Windows.Forms.Padding(2)
        Me.Button1.Name = "Button1"
        Me.Button1.Size = New System.Drawing.Size(81, 23)
        Me.Button1.TabIndex = 0
        Me.Button1.Text = "Cancel"
        Me.Button1.UseVisualStyleBackColor = True
        '
        'ButtonON
        '
        Me.ButtonON.Location = New System.Drawing.Point(12, 12)
        Me.ButtonON.Name = "ButtonON"
        Me.ButtonON.Size = New System.Drawing.Size(161, 23)
        Me.ButtonON.TabIndex = 16
        Me.ButtonON.Text = "Turn ON"
        Me.ButtonON.UseVisualStyleBackColor = True
        '
        'ButtonOFF
        '
        Me.ButtonOFF.Location = New System.Drawing.Point(12, 41)
        Me.ButtonOFF.Name = "ButtonOFF"
        Me.ButtonOFF.Size = New System.Drawing.Size(161, 23)
        Me.ButtonOFF.TabIndex = 17
        Me.ButtonOFF.Text = "Turn OFF"
        Me.ButtonOFF.UseVisualStyleBackColor = True
        '
        'Form1
        '
        Me.AutoScaleDimensions = New System.Drawing.SizeF(6.0!, 13.0!)
        Me.AutoScaleMode = System.Windows.Forms.AutoScaleMode.Font
        Me.ClientSize = New System.Drawing.Size(188, 130)
        Me.Controls.Add(Me.ButtonOFF)
        Me.Controls.Add(Me.ButtonON)
        Me.Controls.Add(Me.Button1)
        Me.Margin = New System.Windows.Forms.Padding(2)
        Me.MaximizeBox = False
        Me.MinimizeBox = False
        Me.Name = "Form1"
        Me.Text = "Edges Hidden by Edges"
        Me.ResumeLayout(False)

    End Sub

    Friend WithEvents Button1 As System.Windows.Forms.Button

    Private Sub ButtonON_Click(sender As Object, e As EventArgs) Handles ButtonON.Click, ButtonOFF.Click

        Dim btn As Button = CType(sender, Button)

        If btn.Name = "ButtonON" Then
            theStatus = True
        Else
            theStatus = False
        End If

        Me.DialogResult = DialogResult.OK

    End Sub
End Class



Public Class MainMethod

    Private Shared theSession As Session
    Private Shared theUF As UFSession
    Private Shared theUI As UI
    Private Shared lw As ListingWindow

    private Shared turnOnEdgesHiddenByEdges As Boolean


    Public Sub New()
        Try

            theSession = Session.GetSession()
            theUF = UFSession.GetUFSession()
            theUI = UI.GetUI()
            lw = theSession.ListingWindow()
            turnOnEdgesHiddenByEdges = False

        Catch ex As Exception

            Throw ex
        End Try
    End Sub

    Public Shared Sub Main()

        Dim theMyClass As MainMethod = Nothing

        Dim theUndoMark As Session.UndoMarkId = Nothing

        Try
            theMyClass = New MainMethod()

            'Call Show form
            theMyClass.showTheForm()

        Catch ex As Exception
            UI.GetUI().NXMessageBox.Show("MyForm", NXMessageBox.DialogType.Error, ex.ToString)
        End Try

    End Sub


    Sub showTheForm()

        Dim theForm As New Form1

        If theForm.ShowDialog() = System.Windows.Forms.DialogResult.OK Then

            turnOnEdgesHiddenByEdges = theForm.theStatus

            processDrawingViews()

        End If

    End Sub


    Sub processDrawingViews()

        Dim workPart As Part = theSession.Parts.Work

        Dim markId1 As NXOpen.Session.UndoMarkId
        markId1 = theSession.SetUndoMark(NXOpen.Session.MarkVisibility.Visible, "Toggle Edges Hidden By Edges")

        For Each vw As DraftingView In theSession.Parts.Display.DrawingSheets.CurrentDrawingSheet.GetDraftingViews()

            Dim views1(0) As NXOpen.View

            views1(0) = vw
            Dim editViewSettingsBuilder1 As NXOpen.Drawings.EditViewSettingsBuilder
            editViewSettingsBuilder1 = workPart.SettingsManager.CreateDrawingEditViewSettingsBuilder(views1)

            editViewSettingsBuilder1.ViewStyle.ViewStyleHiddenLines.EdgesHiddenByEdges = turnOnEdgesHiddenByEdges

            editViewSettingsBuilder1.Commit()

            editViewSettingsBuilder1.Destroy()

        Next


    End Sub


End Class

Suresh
 
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tested on nx8.5
Run to flip/change setting
Run again to restore setting

Option Strict Off

Imports System
Imports NXOpen
Imports NXOpen.Drawings
Imports NXOpen.UI
Imports NXOpen.Utilities

Module list_all_views_on_current_drawing_in_display_part

Dim s As Session = Session.GetSession()

Sub Main()

Dim workPart As Part = s.Parts.Work
Dim draftViews As DraftingView()
draftViews = s.Parts.Display.DrawingSheets.CurrentDrawingSheet.GetDraftingViews()

s.ListingWindow.Open()
For Each draftingView As DraftingView In draftViews
's.ListingWindow.WriteLine(" " & draftingView.Name.ToString)

If draftingView.Style.HiddenLines.EdgesHiddenByEdges = True Then
draftingView.Style.HiddenLines.EdgesHiddenByEdges = False
Else
draftingView.Style.HiddenLines.EdgesHiddenByEdges = True
End If

workPart.DraftingViews.SuppressViewBreaks(draftingView)
draftingView.Commit()
workPart.DraftingViews.RestoreViewBreaks(draftingView)

Next

End Sub

Public Function GetUnloadOption(ByVal dummy As String) As Integer
Return Session.LibraryUnloadOption.Immediately
End Function

End Module
 
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Code: 
Option Strict Off  

Imports System
Imports NXOpen
Imports NXOpen.Drawings
Imports NXOpen.UI
Imports NXOpen.Utilities

Module list_all_views_on_current_drawing_in_display_part

 Dim s As Session = Session.GetSession()

 Sub Main()

   Dim workPart As Part = s.Parts.Work
   Dim draftViews As DraftingView()
   draftViews = s.Parts.Display.DrawingSheets.CurrentDrawingSheet.GetDraftingViews()

   s.ListingWindow.Open()
   For Each draftingView As DraftingView In draftViews
     's.ListingWindow.WriteLine("    " & draftingView.Name.ToString)

     If draftingView.Style.HiddenLines.EdgesHiddenByEdges = True Then
       draftingView.Style.HiddenLines.EdgesHiddenByEdges = False
     Else
       draftingView.Style.HiddenLines.EdgesHiddenByEdges = True
     End If

     workPart.DraftingViews.SuppressViewBreaks(draftingView)
     draftingView.Commit()
     workPart.DraftingViews.RestoreViewBreaks(draftingView)

   Next

 End Sub

 Public Function GetUnloadOption(ByVal dummy As String) As Integer
   Return Session.LibraryUnloadOption.Immediately
 End Function

End Module
 
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Added 'Undo'


Code: 
Option Strict Off  

Imports System
Imports NXOpen
Imports NXOpen.Drawings
Imports NXOpen.UI
Imports NXOpen.Utilities

Module flip_on_off_edges_hidden_by_edges_of_current_drawing_views

 Dim s As Session = Session.GetSession()

 Sub Main()

   Dim workPart As Part = s.Parts.Work
   Dim draftViews As DraftingView()
   Dim markId1 As Session.UndoMarkId
   markId1 = s.SetUndoMark(Session.MarkVisibility.Visible, "Start EdgesHiddenByEdges")
   draftViews = s.Parts.Display.DrawingSheets.CurrentDrawingSheet.GetDraftingViews()

   For Each draftingView As DraftingView In draftViews

     If draftingView.Style.HiddenLines.EdgesHiddenByEdges = True Then
       draftingView.Style.HiddenLines.EdgesHiddenByEdges = False
     Else
       draftingView.Style.HiddenLines.EdgesHiddenByEdges = True
     End If

     workPart.DraftingViews.SuppressViewBreaks(draftingView)
     draftingView.Commit()
     workPart.DraftingViews.RestoreViewBreaks(draftingView)

   Next

 End Sub

 Public Function GetUnloadOption(ByVal dummy As String) As Integer
   Return Session.LibraryUnloadOption.Immediately
 End Function

End Module
 
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I removed these lines and this also work

workPart.DraftingViews.SuppressViewBreaks(draftingView)
workPart.DraftingViews.RestoreViewBreaks(draftingView)

I do not know why


Code: 
Option Strict Off  

Imports System
Imports NXOpen
Imports NXOpen.Drawings
Imports NXOpen.UI
Imports NXOpen.Utilities

Module flip_on_off_edges_hidden_by_edges_of_current_drawing_views

 Dim s As Session = Session.GetSession()

 Sub Main()

   Dim workPart As Part = s.Parts.Work
   Dim draftViews As DraftingView()
   Dim markId1 As Session.UndoMarkId
   markId1 = s.SetUndoMark(Session.MarkVisibility.Visible, "Start EdgesHiddenByEdges")
   draftViews = s.Parts.Display.DrawingSheets.CurrentDrawingSheet.GetDraftingViews()

   For Each draftingView As DraftingView In draftViews
     If draftingView.Style.HiddenLines.EdgesHiddenByEdges = True Then
       draftingView.Style.HiddenLines.EdgesHiddenByEdges = False
     Else
       draftingView.Style.HiddenLines.EdgesHiddenByEdges = True
     End If
   Next

   For Each draftingView As DraftingView In draftViews
     draftingView.Commit()
   Next

 End Sub

 Public Function GetUnloadOption(ByVal dummy As String) As Integer
   Return Session.LibraryUnloadOption.Immediately
 End Function

End Module
 
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Excellent!

I will be honest, I didnt try them all, but this last one being the shortest I tried first and it worked great. Thank you very much. Hopefully I can learn from it and make similar codes on my own so I dont have to keep bothering people here. :o)
 
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If you value succinct code, the following code

Code: 
If draftingView.Style.HiddenLines.EdgesHiddenByEdges = True Then
   draftingView.Style.HiddenLines.EdgesHiddenByEdges = False
Else
   draftingView.Style.HiddenLines.EdgesHiddenByEdges = True
End If

can be reduced to:

Code: 
'toggle value of "EdgesHiddenByEdges" property
draftingView.Style.HiddenLines.EdgesHiddenByEdges = Not draftingView.Style.HiddenLines.EdgesHiddenByEdges

www.nxjournaling.com
 
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Yes that's good
Thank you cowski
But what are those two lines that i removed
What they do.
 
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a984928 said:
I removed these lines and this also work

workPart.DraftingViews.SuppressViewBreaks(draftingView)
workPart.DraftingViews.RestoreViewBreaks(draftingView)

I do not know why
Click to expand...

I'm going to go out on a limb and say that these lines suppress and restore the view breaks. I'd suggest testing the code on a drawing that has view breaks to see what the effect is (if any). Perhaps the view breaks need to be suppressed before updating the view (I'm not sure, I have not tested the code).

www.nxjournaling.com
 
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