Part Family Drawings

[SiW979]

Is it possible to automatically create drawings as part of a part family member creation for each member or is it just a case of a chart drawing at the top level?

Best regards

Simon NX4.0.4.2 MP10 - TCEng 9.1.3.6.c - (NX7.5 native)

http://www.jcb.com

Life shouldn't be measured by the number of breaths you take, but by the number of times when it's taken away...

 

[phillpd]

Drawings and part family templates don't work well together at all, at least when created using the master model approach. You lose all dimension associativity, for some reason.

NX 6.0.5.3
Windows XP32

 

[SiW979]

Just as I thought, thanks Phil.

Best regards

Simon NX4.0.4.2 MP10 - TCEng 9.1.3.6.c - (NX7.5 native)

http://www.jcb.com

Life shouldn't be measured by the number of breaths you take, but by the number of times when it's taken away...

 

[Michel1978]

I don't agree on that. I did that once and was suprised that I didn't loose the associativity with the dimensions.
I just did a save as of the drawing and then replaced the model as I remember correctly.
Did you try this?

Michel

I use NX6.
Groeten, Michel

http://www.kvi.nl

A leading Dutch institute in atomic and subatomic physics

 

[phillpd]

I tested with two template files, one for the solid bodies, one for the drawing files.

I build all of the members for the solids.

I then open the drawing template file, go into the spreadsheet, select a member and click apply values. All of the dimensions become unassociated.

NX 6.0.5.3
Windows XP32

 

[joycejo]

Using a part family member as a component works great. I have been doing this in Manufacturing for a long time and the associtity works. The drawings update as well.

Do not use the Template part only the family members.

Use the family member as a component.

Save the assembly as and replace the component. Depending on the version of NX you may need to close the component and use open component as. The dimensions should update.

If you delete the component and then add a new on you will loose the associtivy.



John Joyce
N.C. Programming Supervisor
Barnes Aerospace, Windsor CT
NX6.0.5.3

 

[Buckshott00]

joycejo is right, plus there is an older thread on here showing how to do exactly what you're asking. It even has pictures. I find it helps if you design your features to datums and then dimension to the datums, NX doesn't lose associativity as much when I do it that way.

 

[phillpd]

I agree, the drawings do update, just so long as the drawing "is not" also a part family template.

Our trial was to try and automate the drawing and component through the use of a part fmaily.

NX 6.0.5.3
Windows XP32

 

[Buckshott00]

phillpd

I am doing the same thing. I think the process that worked best was to use the part family and insert it as a component of another assembly, and then make a drawing template with dimension, and then right click replace component in the drawing.

 

[SiW979]

Thanks guys

We are using only a single component, not an assembly, but I think we will just create drawings for each part manually as they are pretty straight forward, we have achieved our main aim of reducing the time to model these components by using the part family system by 95%+ So happy days. Thanks again.

Best regards

Simon NX4.0.4.2 MP10 - TCEng 9.1.3.6.c - (NX7.5 native)

http://www.jcb.com

Life shouldn't be measured by the number of breaths you take, but by the number of times when it's taken away...