Reference set advice? 1

[TechnicalConsultant]

Our current policy is to only use one reference set (SOLID). When creating left and right handed versions we currenty create 2 ref's and wave link in a mirrored version of ref 1 into ref 2.

However, creating a LH and RH ref set does seem to be very nice way of creating handed version. It also allows easy adding of component to assemblies.

Any comments or views much appreciated

 

[ewh]

We detail only one but create two separate part files, the opposite being a wave link of the primary (because we assign unique part numbers to each).

 

[DavidTolsma]

Usually the left and right components would have a unique part number and possibly some unique features. So I would Wave link the mirror into a new file at time stamp if you want to control what is common between the two.

-Dave
PLM Exchange

http://plmexchange.net

http://groups-beta.google.com/group/NX_CAX/

 

[TechnicalConsultant]

Do you use the "wave geometry linker" to create the link? Am I right in thinking the two references have to be added in to another level together in order to create this link?

 

[ewh]

Yes, we add the two parts as individual components to the drawing file.

 

[TechnicalConsultant]

Thanks!

Would something like this cause a problem though!

http://i106.photobucket.com/albums/m270/mark_noyce/Handed.jpg

Ref 2 would be used twice but ref one would have a mirrored version,would wavel inking not cause a problem as its part of a sub-assembly?

Forgive me If I'm over complicating it ::

 

[ewh]

We would create item one then create a new file for item two, adding item one as a component. We would then wave link a mirrored item one and change the reference set of item one to "empty". The next assy pl should then show each as an individual component with it's correct p/n and qty (provided you have the attributes correct in the components).

 

[DavidTolsma]

WAVE Geometry Linker does require components added to the assembly to make the Link. Insert -> Associative Copy -> WAVE Geometry Linker.

WAVE does not require an assembly to link geometry. You need to enable WAVE Mode if you have the license. Tools -> Assembly Navigator -> WAVE Mode. To use WAVE after you have enabled it, go to the Assembly navigator and right click on the part and select WAVE -> ... Pick what you want to do. Copy geometry to component, part, new part, and other options.

-Dave
PLM Exchange

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http://groups.google.com/group/NX_CAX/

 

[DavidTolsma]

Creating an assembly just to link the geometry when it has no need to be an assembly is not a good answer. Use WAVE if you have the license. If you have to do it this way you would run into an issue that the BOM would be incorrect, then there are tricks to have it not show up in the BOM but if you can avoid that, the better.


-Dave
PLM Exchange

http://plmexchange.net

http://groups.google.com/group/NX_CAX/

 

[ewh]

Dave,
Your advice makes sense, but we don't have the license to do that. The BOM presents no problems as long as the levels are properly set.
Good info, though!

 

[TechnicalConsultant]

I'm back at home now but so can't try it but we definitely have the wave license. I'll give it a try tomorrow and let you know how I get on.

Many thanks to all of you for your help and comments.

Mark Noyce
Senior Design Engineer/CAD co-ordinator

 

[TechnicalConsultant]

This works a treat! Thank you so much!

Mark Noyce
Senior Design Engineer/CAD co-ordinator