Removing chamfers from hole pattern 1

[PrintScaffold]

Hello everyone!

Let's assume we have a circular patern of holes, which are chamfered. Is it possible to somehow select all chamfers automatically for the Deleta Face synchronous command?

http://www.cadroad.com

 

[Sondrkva]

Hello, PrintScaffold!

If all the chamfers where created at once (or in succession), you could just delete the feature(s) from the history tab?
Obviously that assumes that no other geometry is dependant on the chamfers.


Best wishes,
Sondre

 

[jerry1423]

It is possible to select all the chamfer faces at the same time if the face finder filter is available in the menu.

Jerry J.
Milwaukee Electric Tool

http://www.milwaukeetool.com/

 

[JohnRBaker]

If it's a Pattern of holes where the original (master) hole had an included chamfer (as part of the definition of the hole), just go back and edit the original (master) hole and toggle OFF the chamfer option.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[PrintScaffold]

Hello John!

Sorry for not making myself clear from the start. Obviously I referred to the situation when we have a dumb solid. Is it possible to avoid selecting chamfers one by one and pick them all at once?

http://www.cadroad.com

 

[JohnRBaker]

What version of NX are you using?

There is one trick that you could try. If we're talking about something like a flat plate with a bunch of holes with chamfers, you could make sure that you're Multi-Select rule is set to Rectangle and Inside. And then with the 'Allow Multi-Select of Hidden Bodies and Faces' icon on your Selection Bar toggled ON, just rotate the model around so that you're looking at it from the side and then area select just the upper half where the chamfers are located and then hit the 'Delete Face' button. Now you may have to deselect the top face of your model before you actually select the 'Delete Face' item but this can help with what you're doing. Of course, if you've got chemfers on both the front and back side of the model, you may have to perform this task a couple of times to get them all.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[jerry1423]

It's too bad we cannot utilize detail filtering on the delete face menu like it is available on the other (mostly older) functions, that way we could filter out only conical faces (the chamfer on the hole) and delete those.

Jerry J.
Milwaukee Electric Tool

http://www.milwaukeetool.com/

 

[PhoeNX]

@jerry1423, but you can (from NX9 and up).
See attached image.

Anthony Galante
Senior Support Engineer


NX3 to NX10 with almost every MR (21versions)

 

[jerry1423]

Thanks Phoenx, hopefully we will be moving up from NX7.5 very soon

Jerry J.
Milwaukee Electric Tool

http://www.milwaukeetool.com/

 

[JohnRBaker]

Yes, that works (I wasn't aware of that enhancement myself).

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.