Rotated parts list 2

[cowski]

Where is the setting that controls the orientation of a parts list?

I'm asking because I have a part where the parts list comes in rotated at -90°, and I cannot seem to find the setting to fix it. The file was started in NX 8.5, it has since been saved in NX 9 format. Early on I created a parts list that came in at the normal orientation; during work on the project, that parts list got deleted. Now when I try to add one it comes in at the wrong orientation; so something changed between then and now, but I don't know what. Other files from the same project/timeframe are unaffected, so it seems to be part specific. Also, when the list grew it would create new drawing sheets and add the new sections to the new sheets. In the attached file you will see a sheet named "test", this was a sheet I created. Sheets "tesu", "tesv", "tesw", and "tesx" were created by NX when the parts list was added (there were 5 sections in total). It appears to have incremented the last letter of my sheet name to create new ones.

Attached is a copy of my part (with my components removed) if you'd like to have a look.

I take no responsibility if your parts lists start behaving strangely.

www.nxjournaling.com

 

[icconian]

Is your lettering set to a 90 deg slant?

I have nothing useful to offer except a wish that parts list setup would be done with a graphical interface where you could set all the darn parameters (cell size, lettering, downspace, etc) in one window, interactively, and have it stick.

 

[cowski]

Notes and tabular notes work as expected; whatever got changed seems to only affect the parts list.

I like your idea for a graphical options interface. You should submit it to GTAC as an enhancement request if you have not done so already.

www.nxjournaling.com

 

[Arkance/PhoeNX]

@cowski, to me it looks like it's been rotated with the Edit -> Transform command (the pre NX6 one).
I tested and I can rotate it back to being correct.
You need to enable the variable (as per image below) to turn on the Pre NX6 transform menu.

Anthony Galante
Senior Support Engineer


NX3 to NX10 with almost every MR (21versions)

 

[Arkance/PhoeNX]

Forgot to mention that Move Object, won't move the parts list.

Anthony Galante
Senior Support Engineer


NX3 to NX10 with almost every MR (21versions)

 

[capnhook]

Another fine reason that the full Transformations function not be deprecated.

Move Object just won't do everything..

Proud Member of the Reality-Based Community..

[green]To the Toolmaker, your nice little cartoon drawing of your glass looks cool, but your solid model sucks. Do you want me to fix it, or are you going to take all week to get it back to me so I can get some work done?[/green]

 

[cowski]

Actually, I didn't have a problem using the "move object" command; the parts list doesn't update dynamically, but when you press OK it moves.

That's not really the point of my question, though. Delete the existing parts list and add a new one; when I do this it comes in at the rotated orientation. Why? What setting controls this? When I first started working on this part the parts list worked normally, now it does not. I can't seem to find anything in the settings or preferences that would do this.

www.nxjournaling.com

 

[Arkance/PhoeNX]

@cowski, you're right about move object. Funny it wasn't working yesterday, but I try again today and it does work. Must be my old age.

Anyway, if you rotate the parts list back the right way, then delete it and add a new parts list, the new one has the correct orientation.
I also deleted the parts list, saved the part, closed NX, start a new session, open the part and add a parts list and it correct now.

I can only assume that the part somehow remembers the parts list orientation and applies that to any new ones.


Anthony Galante
Senior Support Engineer


NX3 to NX10 with almost every MR (21versions)

 

[cowski]

Anthony,
Thanks for taking the time to look at this file. The process you describe just doesn't work on my machine (see attached .avi). But knowing that it works for you tells me that it may not be part specific, as I originally thought it was. There must be some other setting coming into play on my machine; what that is, I have no idea...

stubborn parts list

www.nxjournaling.com

 

[Arkance/PhoeNX]

I definitely can't replicate what you're seeing. I tested in NX9.0.0 and NX9.0.3 and the result for me is the same in that it works once the parts list is rotated.

Have you tried disabling the dialog memory and any customer defaults to be an OOTB session for NX?
I can't see how either of those can affect it, but it's all I can think of as to where the problem is coming from.


Anthony Galante
Senior Support Engineer


NX3 to NX10 with almost every MR (21versions)

 

[Toost]

Sorry Cowski, on my computer i get the same result as you get, not as Anthony describes.
The partslist comes in 90° off when i 1) rotate the existing. 2) delete the existing 3) save close re-open 4) insert parts list, - It is still 90° off.

Or , rotate the existing, delete the existing, add new. Still 90° off.

The weird thing is that a regular table comes in correct, it's only the partslist that is wrong. ( I assumed that these was "the same math")
I tried adding a table and having the partslist inherit the settings from the table, no success.

Regards,
Tomas

 

[Arkance/PhoeNX]

I'm a support engineer, we can't ever replicate a customer problem!

Anthony Galante
Senior Support Engineer


NX3 to NX10 with almost every MR (21versions)

 

[Toost]

Anthony, The interesting thing is that you get a different result than me and Cowski,
There should be some clue in the environment difference to look up.

Regards,
Tomas

 

[Arkance/PhoeNX]

Found the culprit.
In my case I had the PLIST variable set:

If UGII_UPDATE_ALL_ID_SYMBOLS_WITH_PLIST is set to a non-zero value then parts lists will have the pre-NX2 behavior of updating all ID symbols in the part that have rows in the parts list when the parts list updates. Also, creation of multiple parts lists will not be allowed when this variable is set. Set to 0 to allow multiple parts lists

If I disable the variable, I get the same behaviour you guys were seeing.
And I thought I had a special version of NX


Anthony Galante
Senior Support Engineer


NX3 to NX10 with almost every MR (21versions)

 

[UGperson]

Try and set this variable.

UGII_IGNORE_INTERNAL_PLIST=1

 

[cowski]

What is an internal parts list and what happens when you ignore it? In other words, what is the intended use of this variable and what are the side effects?

www.nxjournaling.com

 

[UGperson]

This is from the NX help file.

"The UGII_IGNORE_INTERNAL_PLIST environment variable must be set if you want the default parts list to be the one you specified in the Customer Defaults dialog box."

When you use it without anything specified anything in the customer default it appears to use the on supplied by NX.

 

[cowski]

UGperson,
The variable you mention works as advertised, it gets me back to what I consider a normal parts list. Thanks for that.

Apparently the variable works by ignoring the part settings and using what is in the customer defaults. This still leaves me with the question: "Where in the part settings is the option to rotate the parts list?" I might throw this one to GTAC to see if they have any insight.

www.nxjournaling.com