Saving a copy of assembly, then creating a drawing of it

[davidinindy]

OK... I have an assembly. I need to create a new version with some components replaced for different options. There is a drawing associated with the assembly.
I saved a copy of the assembly, and have added and changed what I needed to.
Now, I'd like to use the original drawing to create the drawing for this new assembly.
I know I should use family tables to suppress, show etc the components, but others here don't like to use it.
Is there a was to make this drawing reference the new part without having to redimension everything?

David

 

[Guest0527211403]

You could create a backup of the old drawing into a new folder with File-->Backup. This will back up the drawing, assembly and all of it's associated parts.

Once you've done this, rename the files as needed and then modify your assembly. This will save you from having to redo the whole drawing.

Hope it works out!

 

[Heckler]

Check this faq554-1122

Best Regards,

Heckler
Sr. Mechanical Engineer
SW2005 SP 5.0 & Pro/E 2001
Dell Precision 370
P4 3.6 GHz, 1GB RAM
XP Pro SP2.0
NVIDIA Quadro FX 1400
o
_`\(,_
(_)/ (_)

 

[davidinindy]

Heckler
Thanks! I looked right past that not making a connection that it could do what I wanted. I think it would work. I went ahead and created a family instance with the additional parts for now though. I'll try that next time.

David

 

[dgallup]

If your model (part or assembly) and drawing do not have the same name then use this simple approach:

Open the drawing and the model. Do a file/rename of the model, use the "rename in session" option. Do the same thing for the drawing. Now you have a new drawing and model that exist only in RAM, not on the hard drive. Make whatever changes you want to the model and drawing and save. Your original is unchanged.

 

[davidinindy]

Our drawings always have the same name as the models.
I've tried a few approaches, but all are getting complicated when I'm dealing with multiple subassemblies, whose components are used in may assemblies. I definately need to find an efficient way of dealing with these scenarios, as it will come up often.

David

 

[davidinindy]

Heckler, and others having trouble with this.
The FAQ could use some more info for Wildfire.
In Wildfire, you have to add the config
RENAME_DRAWINGS_WITH_OBJECT BOTH
Then you must "Save a copy"
Rename doesn't work.
I think I've figured it out.
Now, to find an easy way to insert this subassembly into my main model.

David

 

[Heckler]

David - Feel free to edit the FAQ to include WF. I'm using the Pro/E 2001 and will not upgrade until PTC gets their act together.

Best Regards,

Heckler
Sr. Mechanical Engineer
SW2005 SP 5.0 & Pro/E 2001
Dell Precision 370
P4 3.6 GHz, 1GB RAM
XP Pro SP2.0
NVIDIA Quadro FX 1400
o
_`\(,_
(_)/ (_)