SHOW SECTION LINES IN MULTIPLE VIEWS

[jkcone]

Hello
Is it possible in NX6 to show a drawing's section lines in more than one view? I'm wanting to show the same section view lines in another sheet in the same file.

James

 

[looslib]

I don't think this conforms to ASME drawing standards.


"Wildfires are dangerous, hard to control, and economically catastrophic."

Ben Loosli

 

[jkcone]

Thanks looslib for the info but in this situation it doesn't matter if it conforms to standards or not, I still have to do it. If I don't the shop floor foreman will call me up & ask where his section lines are for his top half drawing. If the CAD system can't do it I have to do it manually.

James

 

[jerry1423]

You can copy the view to another sheet, but then you will have to manually edit the view label to match the other name - because when you copy the view it will be given a new name.
edit > view > move/copy view > make sure "copy" is toggled on > bottom-middle icon is "to another view"

Let me know if you need help manually editing the view name.

 

[jkcone]

If I can change the copied view from a top view to a bottom view that might work but I'm not sure if NX6 will do that. Do you know if it will & if so how?

James

 

[JohnRBaker]

Open you Drawing, select the view (but it must be a 'Base View', not one created as a projection) you wish to 'flip', press MB3 and select the 'Edit' option. In the Edit dialog in the section titled 'Model View' select the 'Orient View Tool' which will open a 3D window which will allow you to manipulate the view as if you were in modeling. Note that all you have to do is get close because when you do and you press the F8 key, it will snap into place. Now just hit OK and Close the edit dialog and you should be good to go.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
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Cypress, CA

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To an Engineer, the glass is twice as big as it needs to be.

 

[jkcone]

Copying the view to another sheet worked. Flipping the view over work. But the section lines didn't go with it, even before I flipped it. Any suggestions how to get the section lines to go with the view when it's copied to the other sheet?

James

 

[jerry1423]

The section lines should have moved with the copied view, and it's hard to know why they didn't without seeing it.
The first thing that comes to mind is a layer "visible in view" issue
format (pull-down) > visble in view > click on copied view > make sure that the layer that has the section lines is set to "visible" > ok
You may want to compare the original view with the copied view to make sure the visible layers are the same for both views

 

[jkcone]

I just turned on all layers visible in newly copied view. Did a Regen. Still no sections lines from source view.

 

[man2007]

If I have understood your question correctly,

Suppose you have created a section view "A-A" from a parent view "Front1" (for e.g.)

Now you want to show Only "Section lines" on another view "Front2".

Solution:
Goto Preferences->Section Line...
in the Dialog box goto Settings and select "Create section line 'Without Section View'"

Now create section view from "Front2", to create "only section lines"

 

[jkcone]

I don't think that's what I'm looking for.
Let me try & describe this a little better:
I have a NX6 file with multiple drawing sheets.I'm making drawings of a tool with two distinctive halves, a bottom half & a top half. In the first sheet I've placed a "bottom view" with all the visible in view layers turned off except layer one which the bottom half assembly file is on. I then placed multiple section lines on this sheet to created multiple section views which I placed on other sheets. I now need to show these same section line overlaid on the top half but with the bottom not not visible because it would obstruct the view. On this "top half" sheet I've created a "top" view with all the visible in view layers turned off except layer 2 which the top half assembly file is on. I now need the same section lines from the bottom half sheet to show on this top half sheet.

I hope this isn't too wordy.

James

 

[tqqlin]

I have been using UG/NX since V18, this was always an issue. My workaround, move the view with the section lines to a seperate sheet. Use 2D Exchange and export the view to an empty NX part. Open the new part, position the view with a feature of the view @ absolute 0,0,0(defining feature of view). Delete all entities except for the section lines, arrows, and letters. Save part.
Go back to the original drawing move your view back to its original sheet. Now copy that view into the new sheet. The secttion lines will not be there. Now import the part with only the section lines that you created. And pick the origin on the new view the exact same as the one used as the defining feature as noted above. I've used this on drawings where the main view had 20 sections dependant on it. It works perfectly every time. Only issue is the new section lines are not associative.

Rob

 

[man2007]

James,
As per Rob's post, the section lines imported will not be asociated with any view, and are only placed on existing view as curves (or group of curves).

The solution that I had posted was to Recreate these section lines (only section lines) on Top view of "Top Half Assembly" also, similar to bottom view of "Bottom Half Assembly".

Although you are creating Two similar sections (one with section view and one without section view), one advantage you get is, these newly created section lines are not just dumb curves, you can edit them similar to other section lines.

 

[jkcone]

Thanks you all for your input & ideas. I'll have to give them each a try to see which works best in our situation.

James