Showing complete components in a section view

[dav7nine]

Hi guys, hoping someone can help me. Have used ProE and Solidworks before and just started new job using Unigraphics.
I have a problem where I have a cylinder pipe assy with pipes and valves coming from it horizontaly. I want to show the main vertical cylinder in a section view but show the horizontal lines in full. I managed to do the 'Section-View = No' command in the attributes tab and this worked perfect for almost all of the items... but some of the valves on the horizontal lines have handwheels which are further forward than the section line and these are not being shown. Even if I changed the attribute it's like it doesn't see it because it's not being cut in the section.
Is there anyway to show this component in full?

 

[JohnRBaker]

Try this...

Select the section view, press MB3 and select Style. When the View Style dialog comes up, select the Perspective tab, then select the 'Fit Planes to Extents' button and hit OK. See if that solves your problem.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

To an Engineer, the glass is twice as big as it needs to be.

 

[dav7nine]

Hi John, thanks for the reply. Funnily enough that didn't work... but looking at the 'view-style' box I seen the 'section' tab and had a look on there. Right at the top-left 'background' was ticked but not 'foreground'... I ticked that, regenerated and wahaay! I got loads of nuts as well but I'll just blank them off.
Great! - thanks for the inspiration - haha.
Dave

 

[ewh]

So, what happens when someone unblanks all?

"Good to know you got shoes to wear when you find the floor." - [small]Robert Hunter[/small]

 

[JohnRBaker]

So, what happens when someone unblanks all?

Nothing.

Using the 'Hide Component in View' function while in a Drawing is NOT the same things as using 'Hide'/'Show' (AKA Blank/Unblank) and selecting a Component. In the case of the former, the operation effect ONLY the contents of a view, while the latter will effect ALL Drawing views. Your confusion may be due to the fact that the function is called 'Hide Component in View', but back when this was implemented, we were still using the terms 'Blank' and 'Unblank' and so no one confused the two different functions. However, since the name change from 'Blank' to 'Hide' I can see where a new user might miss the nuance that this is somewhat special in that is ONLY produces the 'Hiding' effect in the views selected and NOT across the entire Drawing of the assembly.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

To an Engineer, the glass is twice as big as it needs to be.

 

[cowski]

I think ewh was responding to dav7nine's second post

I got loads of nuts as well but I'll just blank them off.

dav7nine,
Take John's advice and use 'hide component in view', blanking the component may have undesired side effects later on.

 

[ewh]

Thanks. cowski.
Yes, "Hide In View" is different from "Blank", and it was "Blank" that I was refering to.
I wanted the OP to think it through, as "Blank" is not the best choice for this.
Of course, if he meant "Hide In View" when he referred to "Blank", then please ignore my post.
There was a time when "Hide" was actually "Blank", wasn't there?

"Good to know you got shoes to wear when you find the floor." - [small]Robert Hunter[/small]

 

[JohnRBaker]

Yes, at one time what we now call 'Hide' (except in the case of the 'Hide Component in View' function which I already covered above) was called 'Blank' (which is why the keyboard shortcut for 'Hide' is still 'Ctrl+B'). Actually we didn't have any problems with the term 'Blank'. Rather it was 'Unblank', now referred to as 'Show', which was the problem. While English speakers (at least here in the colonies) understood that adding the prefix 'un' to a word changed it to mean the opposite (ever have an 'UnCola'?), that was not the case for non-English speakers. Unfortunately this became a problem when we attempted to localize the wording of the menus and dialogs for languages other than English.

Many of you may not realize this but the 'translation' of the text used in the menus and dialogs in NX is actually done on-the-fly as you're opening dialogs and running the software. Even the so-called 'English' version is actually being translated on the fly, from all lowercase text to the 'Mixed-Case' that you see when you run NX. Anyway, we do this by providing a 'lookup table' for each supported language and then as NX is running the 'strings of text' as it were are passed through some code where the translated strings emerge and are what you see on the screen. Anyway, for each word or string of text, we need to provide the translated word or string of text in the local language. Well the problem with 'Unblank' is that how do we go about translating it into some other language when it doesn't even exist in English? Don't believe me, try looking it up in some dictionary, or open a Word document and type 'unblank'. And while we could have handled as an exception (there are already a bunch which just defies translation and have to be give special care) we wanted to keep these to a minimum and so we looked around the industry and decided that the more common usage was 'Hide' and 'Show' (BTW, we're not the only ones to have had this problem as years ago CADAM used the terms 'Show' and 'Noshow' and believe CATIA did at one time as well). BTW, that was about the same time as we changed a few other terms to more fall in line with standard industry usage such as 'Hollow' becoming 'Shell' and 'Taper' becoming 'Draft', but we refused to change 'Blend' to 'Round' ;-)

Anyway, a little history lesson on why things are they way they are and how they got to be that way.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

To an Engineer, the glass is twice as big as it needs to be.

 

[runemark]

If you want to show both sectioned and un-sectioned components in a section-view, I would suggest the section in view-command.