Showing Dimension Relations 2

[SomeYahoo]

How does one modify a relation after it is created?

Seems easy at first: tools->relations but the relations I have set up are not there. More specifically, I create a relation when in a dialog box (i.e. creating a plane, set the translation to param_1). It asks if I would like to create this relation and I OK it. If I edit definition, the translation input area is greyed out. If I edit, it informs me that "Dimension in PART is driven by relation d1 = param_1."

How does one edit such a relation?

Thanks in advance for any and all ideas.

 

[Guest0527211403]

When you do it that way, it adds a feature relation (as opposed to a part relation or an assembly relation).

In the relation dialog box, change the "Look In" option to Feature, and pick your datum plane, and your relation should pop up.

If you want the relations to all show up in the part level, make the plane (using just a number), then edit its value and enter your parameter. This will add a part-level relation for you.

Hope it works

 

[mjcole]

GensetGuy,

Relations in Pro/E are broken up into different types of relations.

1. Assembly relations d204:2=d204:5 where the :# specifies a part id which is different for each part.
2. Part relations d4=2*d2 relations between top level dims
3. Feature relations sd5=sd4 in a section
4. Pattern relations

If you hit use modify and click a feature the relation will be a part relation. It sounds like you entered the relation within the feature and it will be accessible only from feature relations where you'd select relations and choose feature relations and pick the feature whose relations you want to modify.

If you like controlling all your relations from a single dialog, id suggest using only part level relations. Although it takes a little more work to exit a sketch and enter relations as part relations they'll be easier to modify later on.

Hope this helps!

Michael

 

[SomeYahoo]

Justkeepgiviner gets another star. Thanks for the help.

Good thoughts mjcole. I'll probably have to start doing it at the part level so I can see them all at once. Makes modifications that much easier.

Thanks.

 

[mloew]

There are also the FAQ relating to relations (sorry, could not resist):

Mathematical Operators used in Pro/E Relations faq554-970
How to activate the new user interfaces? faq554-211
Using relation editor backdoor to parameters faq554-1132

Best regards,

Matthew Ian Loew


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