Showing specific hidden lines in drawing views.

[sp1ke727]

I'm working with an assembly drawing. In the front view I have "Hidden lines visable" selected. This shows all the possible hidden lines in the view. It's not what I want.

I tried right clicking on the view, selecting "properties", clicking on the "show hidden edges" tab. Then selecting the objects I want to show hidden. Solidworks will then ask if I'd like to switch to "Hidden lines removed" mode. I click yes and solidwork hides all the lines.

Any ideas on how to do this. In autocad I can just put lines on layers and get the linetypes I want. I'm having a hard time getting the drawing results I want in Solidworks.

Someone suggested to trace over the objects I want to show hidden and make a hidden line layer, but this to me seems conterproductive. I might as well do the drawing in 2D.

2009 btw if that makes a difference.

 

[tristram]

turn to "hidden lines removed"
in graphics area select the part you want to show the hidden lines of. right click and select under component "show hidden edges" and it will only show the hidden lines of that part.

-Joe
SolidWorks 2008 x64 SP 3.0 on Windows XP x64
Dell Percision 490
Intel Xeon 5160 @ 3.00Hz (Duel Core)
8 GB RAM - Nvidia Quadro FX1700 (6.14.11.6262)

 

[sp1ke727]

I gave it a try. Still not working. Not sure what I'm doing wrong. It shouldn't be this difficult should it?

 

[drawoh]

sp1ke727,

This is a somewhat ugly procedure, but it will get the job done.

[ol]
[li]Turn on hidden lines.[/li]
[li]Sketch a couple of lines and make them co-incident to the lines you want to show.[/li]
[li]Turn off hidden lines.[/li]
[li]Apply whatever sketch controls are needed to locate the ends of your lines.[/li]
[li]Make your sketch lines thin and broken (hidden).[/li]
[/ol]

JHG

 

[CorBlimeyLimey]

sp1ke727 ...
Set the views to normal Wireframe mode
In the View Manager, select the view and drill down to the feature you want to expose
RMB on the feature, and select Show/Hide > Show Hidden Edges

 

[sp1ke727]

For some reason that doesn't work as well. I think the only way is to retrace and put it on a hidden layer.

I did get my original method to work with a different assembly. Maybe I have a setting screwed up.

 

[CorBlimeyLimey]

Try running a repair from the SW install disks.

What graphics card and driver are you using?

 

[ShaggyPE]

Something appears wrong sp1ke. Both the method CBL and tristram suggested are working for me.

-Dustin
Professional Engineer
Certified SolidWorks Professional
Certified COSMOSWorks Designer Specialist
Certified SolidWorks Advanced Sheet Metal Specialist

 

[sp1ke727]

It's working. I had the draft quality option selected in the Display Style section of the Property Manager. Switched it to high quality and I could see the hidden objects.

I had to do an extra step on some of the parts though. For some reason they show as solid lines and I had to right click on the edge and select "HIDE EDGE" and that would make it dashed.

Thanks for all your help, guys.

Best