Solidworks Surface extraction to us as a cutting tool ! 1

[SteveG101]

Hi
How do you extract surfaces in Solidworks to use as a cutting tool in another assembly?

 

[StefanHamminga]

Offset with a value of 0 (use in context editing).

Stefan Hamminga
EngIT Solutions
CSWP/Mechanical designer/AI student

 

[SteveG101]

Syefan
If I offset using '0' how do I then use that in a completely new assembly?

 

[StefanHamminga]

You can use the part in both assemblies (the part you store the surface in).

Stefan Hamminga
EngIT Solutions
CSWP/Mechanical designer/AI student

 

[SteveG101]

If I do this I take the history to, its just hidden.
How do I blow the history to just get a clean part?

Its a long tree to get to this stage, so I don't want to take that with the new surface,is there a way to take just the offset 'o' surface into another part?

 

[StefanHamminga]

You can break the connection after creating the part, like this:

Click "Break all"

Stefan Hamminga
EngIT Solutions
CSWP/Mechanical designer/AI student

 

[SteveG101]

Cheer Bud, I thought there was more to it.

 

[SteveG101]

Stefan
Is this, "list external references" in 2006?
Am I missing an option somewhere?

 

[CorBlimeyLimey]

If external references do not exist for that feature, part or assy, then SW does not give the option to list them.

In other words, the option is only offered if external references exist.

​

Helpful SW websites faq559-520​

How to find answers ... faq559-1091​

 

[SteveG101]

OK Guy's
so how do you utilize offset "0" to give external references.

In order to use the surface as a tool in another part?

 

[CorBlimeyLimey]

Insert > Component > New Part into the assy, then create the zero offsets from the existing parts into the new part. This creates a separate part "in-context" to the existing assy and (like any other part) can be used in other assys.

​

Helpful SW websites faq559-520​

How to find answers ... faq559-1091​

 

[rfus]

Stefan has shown how to take a surface body in the feature manager and insert it into a new part, and then break its references.

There are a few ways to do this.

I would do everything in an assembly. Place this new surface part in the assembly, or even just use the part that I originally took the surface from. After placing this part correctly with respect to what you want to cut, You can now go to edit part. You will have to create a copy surface (offset '0') in the part that is being edited from the surface part or the origial part itself. Then use this surface to cut the body.

or....

Go to the part you want to cut with that surface and go to insert -> part. Place the part file into the other part.

RFUS