Text Parameters , for fill text in formats 3

[Velvetk]

Hi everyone!!
I'm creating my personal drawing formats , and i'm trying to put parametric text in to the drawing format.
I need to know the names of this parameters , for now i only know those like: &dwg_name ,&model_name ,&scale. In specific i want to know , if is possible , if there are other parameters , like the author name , comments , date , revision ,ect. Where i can found all of that???
Someone can help me???
Tanks in advance!!!
Have a nice day pro-e users!!!
Bye

 

[cadcamguy]

I think most of those are going to fall under User-defined parameters...they used to have books for this.. ... and I can't find it right now but ;

PI is there and G C1 C2 C3 C4.... 1234

rel_model_name is a good one

there are some more ...

 

[cadcamguy]

another.... rel_model_type

also looks like ;

mp_mass (``path'') for mass

mp_volume (``path'') for volume

mp_surf_area (``path'') for surface area


mp_cg_x (``path'', ``coord_sys'', ``path'') for x-coordinate of center of gravity

mp_cg_y (``path'', ``coord_sys'', ``path'')
for y-coordinate of center of gravity

mp_cg_z (``path'', ``coord_sys'', ``path'')
for z-coordinate of center of gravity

should find more info in your help

proehelp/fundamentals/relations.htm.. or thereabouts..hth

 

[Velvetk]

Tank you cadamguy!!!

 

[mjcole]

DRAWING LABELS
From the Book

&todays_date Adds the date when format is applied.
&model_name Adds the model used for the drawing.
&dwg_name Adds the name of the drawing.
&scale Adds scale of drawing shown at bottom of window.
&type Adds the drawing model type.
&format Adds the format size.
&linear_tol_0_0 Shows default value set by config.pro option
through
&linear_tol_0_000000

&angular_tol_0_0Shows default value set by config.pro option
through
&angular_tol_0_000000

&current_sheet Adds the sheet number of the current sheet.
&total_sheets Adds the total number of sheets on drawing.

Sheet &current_sheet of &total_sheets

You cannot use drawing labels in drawing relations; you can only use them in drawing notes and tables.

Drawing parameters can be shown using
&param_name:d

Parameters for specific parts can be shown using
&param_name:# where # is the component instance id which can be found in relation editor or by switching displayed dimensions in an assembly drawing.

For object parameters like edges surfaces or features use the following syntax.

< > symbols are for display purposes only don't include them
Edges
&<param_name>:EID_<edge_name>

Surfaces
&<param_name>:SID_<surfaces_name>

Features
&<param_name>:FID_<Feature_name>

Michael

 

[Velvetk]

In first of all, tanks for the time spent!!!!
I have a little question: When you tell about the list of drawing parameters can be shown using &param_name:d , where i must put this string ?? in the config.pro??
Tanks again Michael
Have a nice day!!!

 

[mjcole]

If you have any Parameters in your Drawing such as DRAWN_DATE

Which would be seen by going to Tools > Parameters and checking the list, you would display this in a note by typing

&DRAWN_DATE:d

If you type &DRAWN_DATE Pro/E will look for the parameter in the active part and won't display it.

If you had a parameter MODIFIED_DATE in both your parts and drawing templates you use the :d to specify that you want the drawing parameter.

Michael