Thread Notes 2

[UKIDIOT]

How do I change the format of a thread note callout? I looked in the help guide, and it said that you have to change it in the callout_not configuration. But I didn't see a option for that in the config. options. Is there any easier way to do this or am I just missing the option?

Thanks,

 

[ttx]

ukidiot,
You can modify your thread call-outs to contain as much, or as little info. as you like. You need to copy and modify the .hol files. The trick here is the syntax. Here is a link to a PTC article that clarifies the mystery.

Regards,

J.W.

http://www.ptc.com/cs/tpi/107248.htm

 

[UKIDIOT]

ttx,

Could you give me a basic idea of how to do it. Or is there another website that has the information posted? Thanks, alot for the help.

 

[ttx]

UKIDIOT,
Here are the critical steps and (2) examples......

1)Locate the .hol files that are stored in Pro/E.
2)Make copies of the files that you want to change. It is best to make copies and leave the originals intact.
3)Place the new files in a folder of your choice.
4)Change your config.pro file to look for these files.
(hole_parameter_file_path)
5)Modify the .hol file line "CALLOUT_FORMAT". (see below)
6)Modify "THREAD_SERIES" to a custom name of your choice. This new name will appear in the hole creation dialogue box.

I have included below, the header from one of our .hol files. As I have said, the syntax is critical. The spaces between characters must be exactly right.


TABLE_DATA
PRO_VERSION 22
THREAD_SERIES ISO2
CLASS H
TABLE_UNITS metric
DEPTH_RATIO 1.25
CALLOUT_FORMAT &Metric_Size TAP <CTRL-a>x<CTRL-b> &Thread_Depth

On a drawing, this will read.....

MX x X.X TAP (depth symbol) X.XX



Here is an exerpt from PTC...

EXAMPLE: The syntax for the default UNC callout format would appear in
this way (all on a single line) in the .hol file

CALLOUT_FORMAT &Screw_Size &Thread_Series - &Thread_Class TAP <CTRL-a>x<CTRL-b> &Thread_Depth / &Number_Size DRILL ( &Diameter ) <CTRL-a>x<CTRL-b> &Drill_Depth - ( &Pattern_No ) HOLE

NOTE: <CTRL-a>x<CTRL-b> must be typed in exactly as shown. "CTRL",
here, does not refer to the control key on a computer keyboard.

One final note.
You have to restart Pro/E each time to see the changes.

Best of luck,

J.W.

 

[UKIDIOT]

Thanks, alot for the help. I just another question though. I'm looking to change the callout from a single line to a multiline format. To look something like this:

5/8-11 UNC - 2B TAP (depth symbol).400
(diameter symbol).531 (depth symbol).500

Is there anywhere I can get a list of built in parameters with Wildfire 2. Also what are the <ctrl-a> and <ctrl-b>?

Thanks.

 

[ttx]

UKIDIOT,
The note that you want should not be a problem.
Sorry, I do not have any experience with Wildfire though.
As for the syntax....
In my example, I believe that "x" is the depth symbol and
<CTRL-a> and <CTRL-b> are just the characters that Pro/E needs in order to display the depth symbol. Somebody who is more into programming may be able to explain it better.

Anyways....
I believe that; <CTRL-a>v<CTRL-a> gives you a counterbore symbol and that <CTRL-a>n<CTRL-b> gives you the diameter symbol.
If I remember correctly (3) spaces forces the text to the next line....or something like that.

Regards,

JW

 

[Tofflemire]

Hi guys,

Great post, is there a way to control the # of decimal points for the depth of threads and root drill depth?
What would be the PCD (Pitch centre diameter) syntax?

Tofflemire

 

[ttx]

Tofflemire,
The only way that I have managed to effectively control the number of decimal places for 2001 is this....

1.While in drawing mode, select FORMAT>DECIMAL PLACES - then choose your desired value.

2. Now go back to your model and select FEATURE>REDEFINE.
When the hole dialogue box pops up - hit the check mark.

3. Now go back to the drawing and reset the number of decimal places to the default or your usual number for general dimensioning.

I don't know whether or not this is a bug however, with the build that we are using, this is the only way we can get the parametric thread and hole notes to behave properly-and not reset to x.xxx after regeneration.

As for the PCD syntax - good question....

cheers,

JW