To change the geometry line thk back to original in .Catdrawing 1

[CatMann]

Hi All,

I have created a drawing (.Catdrawing)with all the views for the respective .Catpart.. I have changed the line thk
of the Views to '1' and saved the drawing. Now, I'm not able to change the thk back to its original condition..
Normally the geometry comes in '2' thk and filles in '1' thk, so that We could identify what is what. I tried to find if any option is there to change the thk, but i didnt succeed. Reuest you for your quick help.

Thanks,
CatMann

 

[ferdo]

Hi,

Something like

http://www.2htts.com/CATBlog/index.php?itemid=27

?

Regards
Fernando

 

[CatMann]

Thank you very much for the prompt response. But Sorry.. I dont know anything about Catscript...except that I
myself have created some macros..and tried to edit...but nothing worked out..But I have copy pasted your vb script in a macro and saved it. If I run the same its giving some error like compilation error.. in so and so line and column like that...Please try to give the complete code, as I cant edit it..But run it directly. All I wanted to do is to set the thk to the original one that comes when We create a view.

Thanks,
CatMann

 

[ferdo]

Basically the script is doing something which you can do without script...launch Search command Edit - Search - Advanced - In Workbench you can select Drafting then in Type select Line, search all lines, select them and select what thickness you want....

Regards
Fernando

 

[LWolf]

Hi,
have you tried this: in your view's properties, tick off the option of showing fillets and any other optios i.e axis, hidden lines, center line etc. Your view comes now without them. use the search functionality (CTRL F) to do an advanced search for Workbenchrafting Type:Generated Item. select these and then press ok. you can now change the graphic properties of all those lines (to thickness #2)
go now back to properties of the view and toggle back all the tick marks you are interested in having in your view.
if you are interested in performing this search often, you might want to save it as a favourite. then it suffices to call it through the power input line with f:"name you stored the query under in the favourite tab"

 

[CatMann]

Excellent.....simple logic...it worked out...Thank you very very much Mr.Wolf...