Wildfire Drawing View Resize 3

[markborges]

Hi all,

In Wildfire 2.0, how do you resize a drawing view?

For some reason, I have a part that has an oversized drawing view box and with lots of views it is dificult to select the correct view. In 2001, I rember a quick drag a window resizing; but I can not seem to get it to work.

Any suggestions?

Mark

 

[Guest0527211403]

Resize your view: Select View--Right Click--Properties--View Scale

Resize your sheet: Select Nothing--Right Click--Page Setup
!

 

[markborges]

Thanks JKGH,

I know how to rescale my view and now I know how to change my page set-up; however, I am just trying to resize each individual view so that the view boundary is not a mile away from the part. With the huge view boundarys that I have, showing a single view with two projection views on one sheet gives me three views and the view boundary is so big for each, that they are all overlapping one another. It is not a big deal (just irretating), and I have to "pick from list" every time I need to select a specific view.

Does this make sense?

MB

 

[Guest0527211403]

Yeah, I've been there before. A tiny part with a coordinate system way off in the distance making the boundary massive.

Unfortunately I don't know of a way to get around this, I usually just grit my teeth and keep on working

 

[3dlogix]

What you can do is place the view as PARTIAL, and just make a Boundary around the visible geometry. This way, when you click on the view, the actual view boundary limits are much smaller.

Steve

http://www.sprdesign.com

http://www.3dlogix.com

 

[markborges]

Thanks, for the info

Mark

 

[Guest0527211403]

Good one Steve

 

[3dlogix]

All I can say is "stop gritting your teeth".

Thanks for the star!

Steve

http://www.sprdesign.com

http://www.3dlogix.com

 

[5050t]

Did you try hiding the coordinate system from 3D space thus making you boundary smaller? You can also try using layers.

 

[markborges]

I just tried hidding everything and then recreating a view and I get the same result. Like Steve said, creating partial views works well.

Mark

 

[3dlogix]

5050t,

Hiding is only a cosmetic function, it does not remove the actual part geometry (whether it is solid or datum type). Your view boundary is as big as your part bounding box in that particular view orientation.

Steve

http://www.sprdesign.com

http://www.3dlogix.com

 

[jeff4136]

> A tiny part with a coordinate
> system way off in the distance
> making the boundary massive.

If that's a common occurance (modeling in body coords?) you can structure the part datums so CS0 doesn't influence model bounding box. Starting empty create CS0. Create an offset csys referencing CS0 and create no further references to CS0.

 

[3dlogix]

Any datum feature will affect the bounding box, regardless of the parent-child relationships.

Steve

http://www.sprdesign.com

http://www.3dlogix.com

 

[jeff4136]

New part > Clear the Use Default Template tick box >
Ok > Empty > Ok.

Insert > Model Datum > Coordinate System.

Repeat to create CS1, referencing CS0.
Hide CS0 (not important, aesthetic only).

Insert > Model Datum > Plane.

Redefine each plane: Edit Definition and hang it on CS1.
(This is the foundation of my normal start part, assy.)

Create a 1" cube referencing and symmetric about ortho planes.

CS1: Edit Definition and offset it some distance, say 100".

View > Orientation > Refit. Ooh! That's a clue. `;^)

Info > Model Size: 1.7621".

Drawing view boundaries will not be expanded by CS0.

I think it is probably true that any datums other than
coordinate systems will influence model size irregardless of
dependencies.