2 parts, Subtract 1 part from another part

[solid34works]

Hi,
I have 2 parts. I want to subtract one part from another part. Basically I want to remove part 1's material from part 2 because in the assembly part1 will be inside part 2.
Part 1 solid is very complicated and I do not want to go through the same features in the part 2 solid. I just want to import part 1 into part 2, make some mate and delete part 1 material from part 2.

I really appreciate your help.

Thanks,

 

[CorBlimeyLimey]

Use the Combine tool with the Subtract option.

 

[solid34works]

But how do I combine? I open part 2 first and then import part 1 as IGES file. But then I can not do anything.
I would appreciate if you could explain how to import part 1 in part 2.

Thanks a lot.

 

[CorBlimeyLimey]

http://www.youtube.com/watch?v=lMfUNK9fsek

 

[CorBlimeyLimey]

To 'import' a part into another part, you can either use Insert > Part, or just drag and drop.

Convert the IGES files to solid SW parts before trying to combine them.

 

[solid34works]

I do not have access to youtube site from the office network. Is there any text reference or other sites where I can look this thing in details? Please let me know.

Thanks,

 

[CorBlimeyLimey]

The Help files and Help > Tutorials.

Also got to SolidProfessor.com and download their "Learning Management System" for lots of sample tutorials of SWs capabilities.

 

[solid34works]

I can import it now. Now the question is how to mate them properly. I do not see any "mate" options.

Thanks,

 

[CorBlimeyLimey]

Which version are you using?

Earlier versions had to use use the Move Body command.

If you are using SW2009, check the Help Index for mates > in multibody parts.

 

[kellnerp]

This is quite easy and the functionality has been in SW since forever. In an assembly edit the part from which material is to be removed. INSERT/FEATURE/CAVITY and you can subtract with or without shrinkage.

TOP
CSWP, BSSE

http://www.engtran.com

http://www.niswug.org

"Node news is good news."

 

[mjcole]

When you perform the insert part without using drag drop. The property manager the second Group Box >> Locate Part has a check box to launch move dialog which becomes part of (embeded with) the Insert Part feature.

You may also launch Move/Copy afterwards to have the Mates show as a separate feature.

If you missed the option the first time you can right click and edit the Insert Part feature, check off the Locate option and Hit okay to add the mates as part of the Insert Part feature.

http://files.engineering.com/getfil...fb&file=sw_insert-part_launch-move-dialog.PNG

http://files.engineering.com/getfil...672257&file=sw_insert-part_Accessing-Move.PNG

Michael

 

[solid34works]

You guys are very helpful. I cehcked all of your suggestions and each works great.
Thank you so much.