Add a property to Each Sheet in Drawing

[designer22]

I was going through all help and couldn't find a solution to this.

Is it possible to add a property/comment to each sheet of the drawing either from a text or excel file? (Sheet specific).

SW 2009

Thanks

 

[rgrayclamps]

Not a very clear question. What's in the text or excel file?

 

[designer22]

I need to add a custom comment or a description on each sheet of my drawing.

For example: A drawing with 3 sheets of details, each sheets has a different part. I wanted to add comments on sheet 1 as "Apple", Sheet 2 as "Berry" and Sheet 3 as "Cherry" at a particular location on that sheet.

I tried adding a "block", but it shows the same on all sheets.

Any solutions, please.

 

[CorBlimeyLimey]

Notes or Annotations on a drawing are normally linked to a custom property of the solid model.

Check the Help files for link > notes to properties > Link to property

 

[designer22]

Thanks CBL,

I already checked that help files.
This is common to either sheets,models or views.

What I am looking is for individual sheets.

 

[CorBlimeyLimey]

?? Sorry, I don't understand the difference.

Can you explain more? (images would help).

 

[designer22]

Hi CBL,

I need to add a custom comment on each drawing sheet of the drawing file. It should be positioned at a particular location on the sheet. Since it is different on each sheet as I mentioned on the second post, I am looking for either a property link or a macro to automatically fill in these comments in all sheets.

I don't think a property link is possible (correct me if I am wrong). Can someone please help to create a macro to add this to each sheet.

Thanks

 

[CorBlimeyLimey]

So this custom comment is independent of the model being shown in the sheet ... much like the sheet number?

How many different sheet comments would you need?

Could you just use separate sheet formats for each comment?

 

[designer22]

CBL,

This comment is not related to any model in the drawing.
It varies from drawing to drawing.

Yes, exactly like a sheet number.(but different words)

Is it possible to have a macro to paste my comments to each sheet?

I can add a note to each sheet, but need to configure the font type, size etc..and place it properly.(which is time consuming).

 

[smcadman]

Just to clear things up, you DO NOT NEED a property link on the notes because the note is independent of the model on the sheet, is that correct?

You could add a block to your template so it will be the same place on all sheets, then right-click the block and explode it. Now you can have unique notes on each sheet.

Lenny has 2 macros that might work, but the downside is that you have to pick the location of where you want the notes, which means each note on each sheet might be in a slightly different location.

They have a separate .INI file that you can easily modify and personalize the notes to your company standards. There are 2 macros: "CommonNotes_V1" and "CommonNotes". CommonNotes_V1 is the easiest of the 2 to use (IMO): Macro LINK

I've seen a print-date macro that puts a note on x and y location of a sheet but it wasn't easily modifiable to customize for distinct notes. If Lenny's macros were hard-coded with a drawing sheet x and y location instead of having to pick it, then it sounds like it would be exactly what you need.

Flores

 

[kellnerp]

For example: A drawing with 3 sheets of details, each sheets has a different part.

If the notes are tied to a custom property in the part then you choose to link the note to the model on the sheet and it will pick up the text in the sheet's first model view.

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[NomLaser]

What you need to do is create sheet styles for each text.

There are 2 types of drawing templates. You have a drawing template and a sheet format template. The drawing template carries your 'paper' size or document size. This is your physical sheet size that your part fits on and drawing standards.

Then you have a sheet format. This is your title block and any tables that you want to use. You can have your drawing template setup in 2 different ways. One way is to have everything already setup in one template. So you click New->Drawing and you are presented with usually 1 option for a drawing template to start with. This is a set paper size, usually B (11"x17") with a titleblock already inserted.

The other way is to give the user the option to select their paper size and then a sheet style. This could have another company's logo or have metric info in the titleblock...etc.

So for your example, I would either setup new complete templates like in the first example or you can create new sheet styles for each block of text. Either way you should be able to select the sheet or template to use when you insert a new sheet. Or you can right click on an empty area and select Properties and choose your sheet style template.

To setup a new sheet format, RMB and select Edit Sheet. Add your text then File->Save Sheet Format and save it somewhere, preferably on a network that others have access to it.

 

[fcsuper]

You won't be able to use the same custom property across each of your sheets if it is to have a different value. You'll require something that is different on each sheet. You may just be as well of by using a plan old annotation note.

Matt Lorono
CAD Engineer/ECN Analyst
Silicon Valley, CA
Lorono's SolidWorks Resources
Co-moderator of Solidworks Yahoo! Group
and Mechnical.Engineering Yahoo! Group