Adding new notes to views

[jkcone]

Hello
My problem is in NX6 new notes added to existing drawings while in display sheet mode (model mode) aren't automatically visible when toggled back to drawing sheet display mode.
I have to add them to using "view dependent edit".
I have many drawings to update & I'm afraid I'll forget to do this on some of them.
Is there a setting in these files or in customer defaults which will cause these notes to be added to the drawings as soon as their placed?

Thanks,
James

 

[cowski]

I'm curious why you don't add the notes in drawing mode?

Have you checked the visible in view settings?

Also, search the forum. It seems there was a similar post a while back, maybe this question has already been answered.

 

[JohnRBaker]

Sorry, all regular Drafting notes, irrespective of whether you're actually working on a Drawing sheet or not, are automatically created as 'view dependent' (this behavior is as old as UG/NX itself, which means that it's been this way for 35+ years) and there is nothing that can be done to circumvent that.

Now that being said, I have to ask, why were you creating notes in 'modeling' in the first place? If your desire was to annotate the actual 3D model and not just the Drawing, perhaps you should look into the PMI module as this was designed to do just that, and besides, if you later do decide to create a Drawing, the PMI object can be automatically inherited onto the Drawing as you place the views.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

To an Engineer, the glass is twice as big as it needs to be.

 

[jkcone]

The model is a check gage. It consists of basic curves & these notes only. No extrusions. It'll be made of thin material. the curves will be cut through. These notes are etched on it. That's why the notes aren't added in drawing mode, they are in the finished part. Yes I've checked the layer & visible in view settings.

Now to show my ignorance...I don't know what the "PMI module" is. Guess I tend to keep the blinders on. A short explanation would be appreciated.

 

[JohnRBaker]

For your application PMI wouldn't really help as it's intended for documenting 3D models (dimensions, notes & labels, GD&T, etc) as opposed to creating orthographic views on a drawing.

For what you're doing you should look at using the geometric text function found at...

Insert -> Curve -> Text...

...since that is what it was designed for, adding 'text' as geometry to the model itself.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

To an Engineer, the glass is twice as big as it needs to be.

 

[jkcone]

Thanks for the input guys.

James

 

[woodfox]

@jkcone

Do you have a grip license?
Have a look to the upper lines, this a way to do this with the good old GRIP.
We use this method very often for old 2d parts.


***** start ******
$$ Program sets all notes in model area to model status
ENTITY/n_obj
string/v_name(40)
mask/25 $$ notes(draftings) only
INEXTE/ALL $$ cycles for all

L1: n_obj = NEXTE/IFEND,HLT:
v_name = &vwdep(n_obj,iferr,l1
if/ v_name == &nulstr,jump/l1: $$ already model
pos1 = fndstr(v_name,'@',1)
if/ pos1 > 0,jump/l1: $$ exists on drawing
&vwdep(n_obj) = &nulstr $$ set to model
JUMP/L1:

HLT: halt
***** ende ******

best regards

 

[jkcone]

Thanks woodfox,
I'll have to look into the grip license question.

James