How can I add bend anotations (angles) to a flat layout on my drawing so when I modify the Catia part linked to the drawing, the drawing is updated too?
When i start from workbench, the part itself will be changed in the drawing if I modify the part, but the problem is that the bend angles detail in the drawing wont change, even if i change the angles in the part. Is there a way to insert the bend angle in the drawing, let's say 90 degrees, and when i change the angle in the part to 80 degrees, the angle in the drawing get's updated to 80 degrees too?
I am not dimensioning the bend angle at the formed part. I am inserting a text string with the angle in the flat part view. Is there a way to insert the angle dimension in the flat part so it updates when the part changes?
1. add parameters for each bend angle you want displayed on the drawing. for example: BEND1, BEND2, etc.
2. modify the flanges in your sheetmetal part to be driven by the parameters you've just created.
3. verify the parameters are driving the sheetmetal by modify the values of BEND1, BEND2, etc and make sure the 3D model updates correctly
Now, switch to the drawing of the part:
1. make the flat pattern view active
2. add text at each of the bends
3. edit the text, right-click in the text box and choose Attribute Link, and change windows to the 3D part and select the appropriate parameter (BEND1 or whatever)
4. repeat step 3 for each Text, linking it to the parameter.
Now when you edit the parameters, the 3D sheetmetal part will update, the drawing views will update and the text on the flatpattern is update also.
