can't hide hidden edges in section view 1

[Nobu]

System: Using SW2000, windows 2000 service pack 2, Video card is Guillemot's Xentor 32 (nvidia ultra TNT2), 512 MB RAM

Question: In my drawing I have a front view (think of a simple cylinder for simplicity) and a section view (the section is a side view of the cylinder cut vertically right through the center). In the section view I have "hidden in gray" turned ON in order to see a particular hidden thermocouple hole location, which I need to be on my printout. However, there are other hidden bolt hole edges in this section view that I would like to hide or turn off. When I right click on one of these hidden bolt hole edges and hit the option "hide edge" it disappears temporarily only to show up (be visible) again when I zoom in or out. If I again right click on that same (visible) hidden bolt hole edge I only get the option to "show edge" when it is still clearly visible (shows up on printouts as well)! Note I have the "select hidden entities" option turned on otherwise I wouldn't be able to select these hidden edges in the first place. Note this same type of problem appears with other parts/assemblies in my drawing views as well so it can't be limited to just this particular model. I have wondered if this is a video card issue - maybe the card does not properly recognize these lines? I have also wondered if it has something to do with the fact that these hidden line edges are from a cylindrical cut feature in the model and maybe SW2000 has problems working with these kinds of edges? Any help would be greatly appreciated - this problem forces me to continue to use 2D AutoCAD instead of 3D Solidworks to do many of my designs - Arrghhh!!!

 

[MadMango]

Are the hidden bolt lines from just one hole, or are you looking at a row of bolt holes? Sometimes you have to Hide these lines more than once.

But you did say that clicked on them a 2nd time, and you only had the option to Show, so there is only 1 bolt hole. What you can try to do is Hide all hidden lines, then only select the thermocouple edges and make them Visible.

Not sure about your video card, it might be the cause. To make sure it is, you could email me your part or a similar part and I could test it on my machine.

rreynolds@riconcorp.com "Happy the Hare at morning for she is ignorant to the Hunter's waking thoughts."

 

[Nobu]

I apologize for not responding earlier in the week - I was not feeling well. Anyways I tried your advice but still could not get it to work right. When a hidden line appeared under my pointer I right clicked but only had the option "hide edge". I clicked "hide edge" then immediately right clicked the same hidden line to see the option "show edge" which I then clicked. The hidden line then turned into a solid black line but then disappeared after I zoomed in. Not sure what's happening here. However, I would like to take you up on your offer to check my drawing on your video card. I will email you both the part model and drawing. I appreciate anything you can tell me.

Thanks.
Nobu

 

[MadMango]

Ok, I looked at your file. I am using SW01Plus, so not sure what that may mean. However, when I select Hidden In Gray I do not see any other hidden lines, except for one vertical line near the right edge of your Section A-A, and one vertical line at the left of your section.

I do see the thermocouple hole only, and do not see any other horizontal hidden lines in your section view.

In the views at the top (outside the drawing border) I am able to hide all the hidden lines from the vircular patterned holes, keeping only the hidden lines of the thermocouple.

I'm thinking it might be your video card, but really hard to say since I am using a different version of SW to view your file. "Happy the Hare at morning for she is ignorant to the Hunter's waking thoughts."

 

[BBJT]

Do not no if this is the problem you are having but you might want to give this a stab.

We had a file that was giving us a similar problem. We could not hide a edge that was behind the edge that we just hid. The only option when right clicking was show the edge that we just hid.

Right-click on the edge(the one that the only option is to show) and select other and left click for yes. Now hold down you cntrl-key and right-click on the edge at the same time. The pull-down will have a show edge and a hide edge in it. Select the hide edge. Make sure you do a redraw to see the results. Same goes for showing them both. Right-click on the hidden edge and pick show. Rick click on the edge again and pick select other and left click for yes. Hold down your ctrl-key and right click on the edge you will see the show and hide, select the show and now both edges are shown.

Hope this works for you.


BBJT CSWP

 

[Nobu]

I am really thinking it probably is my video card that is to blame. I tried BBJT's suggestion on the hidden hole edges but was not able to get the "show edge" and "hide edge" in the pull down box after holding down cntrl and right clicking. It would only give me the "show edge" option. However, I was subsequently having a similar problem with 2 hidden tangent edges on top of each other on a completely different part drawing. I tried BBJT's suggestion again and at first it did not work - I was only able to hide one of the two hidden tangent edges. I then right clicked and unhid the one edge to try again. This time I held down the cntrl key the whole time as I followed BBJT's instructions and voila - I got both "hide edge" and "show edge" on the pull down box! I now have both edges hidden as I desired. In this case, note these hidden tangent edges are from an external slot (cut with ball endmill) as opposed to the internally drilled holes as in my original part - so maybe that has something to do with it as well. One other interesting observation - while editing a solid part (not a drawing), and looking at a side view of a circular edge, I sometimes have to slightly rotate the part in order to be able to select that circular edge on the part - again probably a video card issue. Anyways I am happy to have at least one problem solved and hopefully this thread helps others as well. Thanks both to MadMango and BBJT!

 

[BBJT]

One of our users sent me another file that we are having a similar problem with. I have tried it on three separate machines all with different video cards and received the same results. This, in my eyes, rules out video cards. I am sending the file to my VAR today which in turn they will probably send it to SolidWorks. I will let everyone know what I find out. I am also going to call it up in SolidWorks 2001Plus to see if I receive the same results.

Happy modelings-) BBJT CSWP

 

[BBJT]

Hello All,
I pulled up the file that we were having an issue with, in SW2001Plus, and had no problem hiding the edges that were giving us a problem in SW2000. It looks like it was a bug that was fixed.
This is probably why, when MadMango pulled up your file in SW2001Plus, he did not see the issue.

I guess this just goes to show how important it is to keep up with the times. I am starting to think that SolidWorks should come out with new releases once a year instead of every 6 months. A lot of the enhancements could be Super Service Packs. It is really hard for a large company with a large user, customer, and vendor base to keep up with the new releases. If the software was backward compatible it would be a whole different ball game. BBJT CSWP