Chamfer or Fillet a portion of an edge

[tmalinski]

Is there a way to abruptly terminate a chamfer or fillet at some position along an edge? I have been splitting the part into two bodies chamfer the edge of one of them, and then combine the bodies back together. This works, but seems to be the hard way...and in some cases I can't split the part because previous features fail.

tom..

 

[MadMango]

I usually insert a Plane at teh start point of the feature, then cut-extrude a chamfer or fillet the desired distance to get it to terminate.

[green]"I think there is a world market for maybe five computers."[/green]
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[J-C]

Post a pic if you can.
All, uncheck tangent propogation and select the edges manually.

Jason

UG NX2.02.2 on Win2000 SP3
SolidWorks 2005 SP5.0 on WinXP SP2
SolidWorks 2006 SP1.0 on WinXP SP2

 

[tmalinski]

http://img7.imageshack.us/img7/2729/chamfer7ml.th.jpg

[/IMG][/URL]

Click the link above, Here is a simple pic of a chamfer along an edge but stops short at some point. I did this by splitting the body in two, and then chamfering one of them then combining them back together. I was hoping for an easier way.

Thanks MadMango, I have done what you suggest also

tom..

 

[dogarila]

Draw a sketch for your chamfer then do an extruded cut

 

[J-C]

For that part, I would just create the chamfer as an extrude cut with the depth needed.

You also do a split line on the face to get two edges, then chamfer the edge.

Jason

UG NX2.02.2 on Win2000 SP3
SolidWorks 2005 SP5.0 on WinXP SP2
SolidWorks 2006 SP1.0 on WinXP SP2

 

[CorBlimeyLimey]

Gildashard ... That was the first thing I tried (split line/two edge) & it did not work??? The fillet continued past the split. Did I miss something?


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[tmalinski]

I have tried many of the suggestions posted here and most work depending on the feature to be chamfered. I appreciate all the feedback, but I was just hoping there was some hidden functionality that I wasn't aware of like dragging the highighted line in the chamfer preview or something similar to Edge Flange dragging to change its width. It would be neet if SW added a optional start position and end position in the fillet and chamfer control dialog box.

tom..

 

[CorBlimeyLimey]

Submit an Enhancement Request to SW.


Helpful SW websites faq559-520
How to get answers to your SW questions faq559-1091

 

[smcadman]

As you know, there is more than one way to skin a cat. Though you want a one-button solution, the easiest way would have been to draw a triangle and use an extruded-cut. It's like taking the long way around trying to find a shortcut.

Flores
SW06 SP1.0

 

[bhart]

Also, if you would like a break out radius/cutter radius at the ending, you can sweep a triangle along a path... I do this probably once every 3 months or so, and it actually comes out looking nice and you can even dimension the runout radius.

 

[rfus]

If you haven't heard of it, check out the Atomic Bomb Fillet technique.

Find the technique in the blending fillets tutorial here

http://home.pct.edu/~jmather/content/DSG322/solidworks_surface_tutorials.htm

You can adapt this method to all kinds of stuff, such as damming or stopping you fillet or chamfer.

RFUS

 

[fastasleep]

I've run into the same problem, and came up with the following solution:

1) create a plane at opposite angle from chamfer angle along the edge to be chamfered and from adjacent plane (in the case of the example I used the front plane and created a 135-deg plane for a 45-degree chamfer)

2) cut-extrude - sketch a rectangle, specify length of chamfer, add radius at end(s) of cut.

 

[fastasleep]

Oops...forgot to mention, the cut-extrude feature is from the sketch plane, through-all, in both directions.