Changing color of "forced" dimensions

[davidinindy]

I am making some drawings of parts someone else modeled.
The show and erase dimensions has some dimensions at 4 place decimals, some at 3, 5 etc...
Most need to be only 2 places, a few need to be 3.
I changed them using the properties, as usual, but when the original modeler looked at my drawings, he asked why some dimensions were yellow, and others were green.
We figured out that the ones that were green were ones I changed the decimal place display on.
My problem is that I am bad with colors... pretty much colorblind. I couldn't even tell the difference between yellow and green on the screen. Having been a CAD designer for 15 years, I've always managed to find ways to get by... ussually by personallizing the way drawings display on my screen, and using colors in my models that are very different. (not using blue and purple, or yellow and light green, etc...)
I'd like to make the green a darker shade that I can distinguish.
I looked at system colors, but don't see anything there.
As usual... Pro/E's help was no help.
Hopefully you folks can give me some guidance.
Thanks in advance.

David

 

[Tofflemire]

Hi David,

From a fellow color sensitive ProE designer, I did not know that the dimensions did what you explained above. You can set the default_dec_places in the config.pro. You might be able to set the colors.
Why does this matter what color these are, you can always look at the number of decimal places when you click modify a part feature, the X.XX or X.XXX is what shows on the screen?

Tofflemire

 

[mjcole]

Usually from what I've seen the modified Dimensions also display thicker in drawings when printed or plotted out.

Maybe saving a pdf from the drawing might help you distinguish the green modified dims.

Green is by default the color used to show modified dimensions in the model so you know the model is not displaying them at the value shown.

I know it used to be that if you changed the decimal places shown Pro/E would actually modify their values to the rounded dimension. A 1.875 value modified to 2 dec places would no longer be 1.875 it would be changed to be 1.88 as shown. I'm not sure if that is still the case, but if it is then you can do the following to keep their original value and show with the decimal places you desire.

Create a drawing dimension and edit the decimal places on that. Since it is a driven dimension the decimal place modification will not change your models accuracy.

You can also create a drawing relation &DD# and set it equal to a model dimension. then in the text editor put &DD#[0.2] where [0.2] represents parameter displaying with 2 decimal places.

Michael

 

[Guest0527211403]

The green dimensions indicate that they have been changed in the model and have not yet been regenerated. Regenerate the model from the drawing and the dimensions should all become yellow.

You're actually changing the value itself. Pro/E needs to interpret the tolerances based on the accuracy you give it, so for example, 1.875 +-.005 would become 1.88 +- .01, and has to go through a regen at these new nominal dims.

If you're using the Dim Bound function for tolerance analysis this makes a big difference.

 

[davidinindy]

Thanks guys. This helps clear it up.

David