drawing BoM/drawing list - AP203

[kevwoogs]

Is there a way you can customize the default AP203 format when creating a bill of materials/parts list for a drawing. You can define your own format, but when you close the model/session it is lost and reverts to AP203.

Any suggestions ?

Thanks - Kevin

 

[DBezaire]

Kevin, I have created some scripts for this. Actually one of the few "easy" scripts to make. Run it before you analyze the BOM. To create the script. Start the macro record, go to analyze bom, set the options, close the macro.

Here is a sample.

Language="VBSCRIPT"

Sub CATMain()

Set productDocument1 = CATIA.ActiveDocument

Set product1 = productDocument1.Product

Set assemblyConvertor1 = product1.GetItem("BillOfMaterial")

Dim arrayOfVariantOfBSTR1(0)

assemblyConvertor1.SetCurrentFormat arrayOfVariantOfBSTR1

Dim arrayOfVariantOfBSTR2(5)
arrayOfVariantOfBSTR2(0) = "Quantity"
' arrayOfVariantOfBSTR2(1) = "Type"
' arrayOfVariantOfBSTR2(2) = "Source"
' arrayOfVariantOfBSTR2(3) = "Number"
arrayOfVariantOfBSTR2(1) = "Part Number"
' arrayOfVariantOfBSTR2(5) = "Revision"
' arrayOfVariantOfBSTR2(6) = "Definition"
' arrayOfVariantOfBSTR2(7) = "Nomenclature"
arrayOfVariantOfBSTR2(2) = "Product Description"
' arrayOfVariantOfBSTR2(9) = "Source"
' arrayOfVariantOfBSTR2(10) = "Default Representation Source"
' arrayOfVariantOfBSTR2(11) = "Comment"
' arrayOfVariantOfBSTR2(12) = "List Of Named URLs"
arrayOfVariantOfBSTR2(3) = "Material"
' arrayOfVariantOfBSTR2(14) = "Vendor"
' arrayOfVariantOfBSTR2(15) = "Process"
arrayOfVariantOfBSTR2(4) = "Block Weight"
arrayOfVariantOfBSTR2(5) = "Comment"
assemblyConvertor1.SetSecondaryFormat arrayOfVariantOfBSTR2

End Sub

Regards,
Derek

 

[kevwoogs]

Thanks for this.

I need it to read - Number (from generated number command in product), part number (actual file name), Description (nomenclature) and Qty (No of parts - 1st level only).

I should be able to figure it out, but only just started using VB, if you could help it would be extremely appreciated!

Thanks - Kevin

 

[kevwoogs]

Its OK, I have figured it out.

Thanks - Kevin

 

[kevwoogs]

Just realised another problem!

Trouble is that In my BoM/parts list on my drawing I only whant 1st level of parts to appear (as in the spec tree in product) as would be normal on most engineering drawings.
I think the problem is when you number the parts/products in the product, It numbers all components including parts of sub product.
Can anybody help?

Thanks - Kevin

 

[DBezaire]

Kevin - There is a toggle on the property page - Visualize in Bill of Material. If you activate at the product level, all sub components do not appear. Most companies make scripts to accommodate their needs for a BOM.

Regards,
Derek

 

[anandara]

There is a toggle on the property page - Visualize in Bill of Material. If you activate at the product level, all sub components do not appear. Most companies make scripts to accommodate their needs for a BOM.

Can you please explain the above.
In our company we are trying to develop BOM software.

thanks