Drawing Questions

[sourcec0d3]

Hi all,

So far I've been able to pretty much get Catia to do what I am needing it to do. There are a few things that I still can't figure out however and was wondering if anyone can offer any solutions or insight to somewhere I may look to answer these questions.

1. I've attached a small screenshot showing two section view arrows. The one on the left is how it is showing up in Catia and the one on the right is how I want it to look. I can't find any options or anything to get the line that's over running to stop at the vertical line. Anyways, long story short I need it to look like the arrow on the right side of the jpeg.

2. Hopefully this is an easy one, by default I want the axis systems to stop showing up in each drawing view.

3. Under each view properties you can show 3d points which I like to do. Right now the size of those symbols are scaling by the current zoom level of my drawing. Is there a way to lock the size of the symbol? or define the size of those symbols?

4. When I make a breakout view there's an option in the breakout view dialog that is called 'reference element'. I'm assuming (and the Catia documentation also agrees) that I can a reference element to control the depth of my breakout view. However every single part view I've tried to do this with will not allow me to select any type of edge or face so I'm just guessing what the depth is going to be. How do you select the reference edge? Is it only a specific type of edge or plane or part that will allow you to use this option?

Thanks in advance for looking and any solutions or push in the right direction would be greatly appreciated!
SC

 

[bradmac65]

I can help with some of this.

For item 1, I've attached a screen shot of the dialog box that comes up if you right click on the section callout and select properties. To get the line to not over run, choose the highlighted option for Position by anchor point that says start - versus middle. To alter the arrow head size and shape, this can also be done from the same dialog box by playing with the Head length and angle. I'm sure there's a way to set these things as defaults, but that's a little beyond my knowledge.

Item 2 can be solved by going to Tools --> Options, then selecting the Drafting option on the left under Mechanical design and the General tab at the top. There is an option for View axis, display in the current view - unselect the box.

The other items I'm not sure about, hopefully someone else can provide insight for you on those.

Brad

 

[DBezaire]

SC

1. I don't know if you can change that in the admin settings. I had a quick look and did not see anything.

2. Tools - Options - Mech Design - Drafting - General - View Axis -- Display in current view, uncheck this.

3. Tools - Options - Mech Design - Drafting - View - Project 3D point - configure -- check 3D symbol inheritance. I thought this might control the zoom but that is a NO.

4. You need 2 views for this. Create a front and a projected view. Create your break out view from the Front view. Select reference element box in the 3D viewer. Now pick a face,edge,axis in the projected view.


Regards,
Derek


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