Eng-Tips is the largest engineering community on the Internet
Intelligent Work Forums for Engineering Professionals
-
Congratulations waross on being selected by the Tek-Tips community for having the most helpful posts in the forums last week. Way to Go!
How does a Fatigue analysis software use a FEM model in life estimation calculations? 1
- Thread starter Znjmech
- Start date
Student BE
Bioengineer
When you perform fatigue analysis, static structural simulation is evaluated first to calculate stresses and strains under single load of given value. Then results obtained from it are combined with material models and load cycle characteristic to calculate fatigue life.
you input your fatigue loadcases into the FEM, get your fatigue stresses, and "analyze them" (typically miner's rule, cumulative damage). There are specialised codes (ncode) for doing this directly, or you hand calc it.
another day in paradise, or is paradise one day closer ?
another day in paradise, or is paradise one day closer ?
-
1
- #4
Assumptions: large structure, elastic analysis
1. Determine the no. of load input points or channels.
2. Collect the load histories for these channels.
3. Perform unit load analysis in FEA for each channel.
4. Software then determines simultaneous max and mins
across all channels. This results in a reduced
set of loads but hopefully will contain all significant
events.
5. Using the simul. max mins and the unit loads applies superposition
to determine the x,y & maybe Z elastic stress histories for
each element.
6. determine the critical stress direction (max principal histograms,
2D or 3D ) for each element. Then calculate the normal stress
history in this critical direction for each element.
7. Rainflow cycle count this normal stress for each element.
8. Applying a Neuber type plasticity correction to determine element's
elastic and plastic closed stress-strain hysteresis loops.
9. Do a Palmgren-Miner damage estimate for each element.
10. Select a user determined number of max damaged elements. Number
depends on computer available.
11. Repeat steps 5 to 10 for all the max damaged elements using the
full load history of each channel, multiplied by the unit loads,
and superimposed.
12. Take life predictions and adjust by a user determined (from
experience) safety factor.
1. Determine the no. of load input points or channels.
2. Collect the load histories for these channels.
3. Perform unit load analysis in FEA for each channel.
4. Software then determines simultaneous max and mins
across all channels. This results in a reduced
set of loads but hopefully will contain all significant
events.
5. Using the simul. max mins and the unit loads applies superposition
to determine the x,y & maybe Z elastic stress histories for
each element.
6. determine the critical stress direction (max principal histograms,
2D or 3D ) for each element. Then calculate the normal stress
history in this critical direction for each element.
7. Rainflow cycle count this normal stress for each element.
8. Applying a Neuber type plasticity correction to determine element's
elastic and plastic closed stress-strain hysteresis loops.
9. Do a Palmgren-Miner damage estimate for each element.
10. Select a user determined number of max damaged elements. Number
depends on computer available.
11. Repeat steps 5 to 10 for all the max damaged elements using the
full load history of each channel, multiplied by the unit loads,
and superimposed.
12. Take life predictions and adjust by a user determined (from
experience) safety factor.
- Status
Similar threads
- Locked
- Question
- Question
- Locked
- Question
- Locked
- Question