How to change the "Owning Layer" of a feature

[DasOK]

Hello all,

I'm new to the forum and first of all I would like to tank everybody for all the valuable advice I have found here!

But now I have run into an issue to which I could not find anything in the Web.

I Like to have the final solids on Layer 99 in each component. When I export my assembly to a step file I use the option to only export that specific layer (layer 99, see pic 1).

Usually, that works fine. But if the final solid has accidentally been created on another layer (say Layer 10) I cannot change the Layer of that solid to layer 99 so that the step converter will understand and it tells me, that there is no solid to be translated (see pic 2).

I assume it has something to do do with the fact that the "Owning Layer" (3MB->Information, pic 3)...

...does not change when I use the "Move to Layer" command.
Only the layer in the part navigator changes as expected (pic 4)

Is there anything I am missing or is the "owning layer" not what I think is? Or is there a smarter way to export only certain solids of a part to a step file?

Tank you so much for your Help!

p.s.: I'm on NX11.0.2.7 MP1 by the way

 

[cowski]

Are you working in a single piece part file or are you working in context of an assembly?

www.nxjournaling.com

 

[DasOK]

I'am working in assemby context. I'll check if I have the same issue in a single part file tomorrow.

 

[DasOK]

I just tried changing the layer of a feature within a single part file. That works fine, the layer in the part navigator AND the "Owning Layer" in the information window changes accordingly.
When I add that part file to a generic assembly, changing the layer only affects the layer shown in the part navigator but not the "Owning Layer" in the information Window.
Why is there a difference in depending of whether or not I'm working in assembly context?

Tanks for you Help!

errr, thanks, not tanks...

 

[cowski]

The display part controls the csys and layers. When you add a component to an assembly, you have the layer option choice of "original" or "as specified". If you pick "as specified", all the component geometry goes to the specified layer in the assembly file; if you choose "original", the geometry on each component part layer will appear on the corresponding assembly layer. Sometimes the layer settings of subassemblies get out of sync with the main assembly. There is an option somewhere (properties dialog?) to synchronize the layers.

In your case, I'm guessing that either:
1) the layers got out of sync
2) you used "as specified" when you wanted "original"

www.nxjournaling.com

 

[DasOK]

Thanks cowski,

I found that I had two different things not quite right. One of them was that my layers on assembly level were not set as "original" as you assumes.
The second thing I did not know is that if I want the "owning layer" to change on assembly level (not only the layer shown in the Part navigator) I have to either open the part separately (without assembly) or make the part "displayed part" in assembly context.
So my Issue is solved for me now, thanks for your help.

What still confuses me though is why I have to make the part "displayed part" first and why the level is indicated differently in the information window and the part navigator. Is there any reason for that?