Insert/curve/text with attribute

[Lars1978]

Ha All,

When i'm in the modelling mode of NX11.02 i'd like to add a text on a surface. I select the face and edge manually.
I like to reference a part attribute already listed in the attribute list.

Now the question is: how do I reference a part attribute instead of a expression? (it seems I can only select a expression)

Kind regards,

Lars

Lars
NX11.0.1.11 native
Solid Edge
Inventor

 

[Dave K]

Create an expression, that is tied to that attribute.

-Dave

NX 9, Teamcenter 10

 

[cowski]

Since NX 8, attributes and expressions are closely related. In fact, part attributes are saved as expressions. You can reference the existing attribute expression, but you may need to "persuade" NX to show it to you first. For example, let's assume you have a part attribute named "TEST" that you want to reference; in the expression editor, create a new expression that references the "TEST" attribute. The attribute expression will now show up in the expression list; the source will be listed as "(Part attribue:TEST)". You can delete the new expression that you made, as you won't need it now - you can reference the name of the attribute expression directly.

www.nxjournaling.com

 

[Lars1978]

cowski,

when I try the thing you mention above still nog part attributes are showing? I've added the "TEST" attribute within the properties dialog.
How do I make a new expression that references the "TEST" attribute. I can only make a new expression ?




Lars
NX11.0.1.11 native
Solid Edge
Inventor

 

[cowski]

Right click the formula field of your new expression and choose "edit"; this will show a dialog where you can choose a part attribute to reference.

www.nxjournaling.com

 

[Lars1978]

cowski that works ok.

Is it possible to load all attributes into the expression list at once?



Lars
NX11.0.1.11 native
Solid Edge
Inventor

 

[cowski]

I don't know of a way to do that. I think NX keeps them hidden until they are referenced.

www.nxjournaling.com

 

[Dave K]

I don't know how to do it all at once, but if you are doing a lot of them, and in multiple parts, I would create them in the model seed file, so they are always available.

-Dave

NX 9, Teamcenter 10

 

[Lars1978]

Dave,

I wrote (in fact Cowski) wrote a journal which creates 3 part attributes out of the file name. These are; , "document number" "revision number" and "title"
I use these attributes to fill the title block of the draft.

I did use expressions first to fill the title block but the "update for external reference" takes to long.

Now when is start using expressions again is have to use the "update for external reference" again

Maybe it's best to make the expressions in the same journal as the attributes are made?

I use these expressions to make a curve text for engraving sheet metals.







Lars
NX11.0.1.11 native
Solid Edge
Inventor