Link refused?? 1

[toyayo]

I created a CATdrawing from a stp file(saved as a CATpart), now I have an updated stp file of that same part. When I try to replace the link to the new Catpart(from the new stp), I get a error, 'Link refused', is it possible to re-link my drawing to the new file? I hate to recreate the whole drawing....

Thanks

 

[Arunfrominfy]

Don't try to replace the links with the new part.

Open the drawing and open the linked part.
Now save the drawing as next version and save the part as next version(Just in case you want to retain the old dwg and part).

Now you have 2 new components in your V5 session(new dwg and new part). For eg DWG_2 and PART_2

Now open the new step file and save that as catpart. This is PART_3.The STEP file conversion makes a dumb solid and dumps it under part body.

Replace the dumb solid in PART_2 with the dumb solid of PART_3.
Now try updating the DWG_2. It should update now.

Hope this helps.

Arun

 

[toyayo]

Thanks Arun, I will give it a try.

 

[itsmyjob]

this is a UUID problem...

Each file does have a "secret number", the UUID which makes (almost) each file different.

So even if you have a drawing link with "Mypart.CATPart" in folder "OLD PART" you cannot relink your drawing to the file "Mypart.CATPart" in folder "NEW PART".

The name is the same but not the UUID. If you want to do that you need to build "Mypart.CATPart" in folder "NEW PART" from "Mypart.CATPart" in folder "OLD PART". Because the new file is build from another, it does have the same UUID.

You can do that using file/new from, or you open "Mypart.CATPart" in folder "OLD PART", make some change and save as "Mypart.CATPart" in folder "NEW PART"

With that you will be able to relink your drawing with the new file, but keeping the dimension link is another story...

Eric N.

catiav5@softhome.net