Modify by dragging 4

[caruana]

I am a Pro/E 2001 user and would like to disable the option that allows you to modify the sketch of a protrusion or cut directly by choosing and dragging a vertex/entity/center from the screen.
Can anyone help?

 

[im4cad]

Try working with "Intent Manager" disabled.

im4cad
Pro Design Services, Inc.

http://www.cadproe.com/pds/home.asp

 

[ohio30]

By default Intent Manager is on when sketching. Use the config.pro option sketcher_intent_manager set to no if you want to start the sketcher without Intent Manager turned on.
For those users who are more familiar with the old sketcher-Intent Manager can be overwhelming. You have to change the way you sketch from start to finish, but in my opinion Intent Manager saves plenty of time. (Intent Manager on - define dimensional references first, sketch, constrain/dimension; Intent Manager off - sketch, trim entities, align entities, dimension, regen.)
I have used both methods for sketching and Intent Manager is far better than the old method.
If you like some of the Intent Manager functionality I would suggest that you do not highlight the entities, (vertices, lines, arcs, etc.) so that they are not changed.
If you are clumsy with mouse picks then try locking the dimensions that you do not want Intent Manager to modify.
Lock a dimension - pick/box the dimensions 2) Select "Toggle Lock" in the Edit menu.
The selected dimensions are now locked and can only be changed by modifying their corresponding values. (Try moving the lines or vertices) Intent Manager will not adjust the dimensions when locked.
Notice that all locked dimensions will have the letter "L" adjacent to their value. Also, locking a dimension in the sketcher mode is only valid for that particular sketch. Once you exit the sketch (the check mark button) the locks are removed from the dimensions.

Have fun!

 

[caruana]

What I meant was not in sketcher but when you are spinning/zooming/panning the 3D model on your screen and you click modify on a protrusion or cut the cursor turns into a hand that can grip vertexes and drag them.

 

[ttx]

Ahh yes.....
The "sticky hand".
The build we are using has a bug. Sometimes the cursor will turn into the hand and stay that way!! We have to restart Pro/E to make it go away....
I suspect that there is a config.pro option that will work for what you are after.

Best of luck

 

[asend]

tx
Yes, the "sticky hand", don't exit proe just reactivate window. It works for me. My two cents.
Thanks
AS

 

[caruana]

Yes that "sticky hand".
Does anyone know of a config option to disable it?
Thanks

 

[mjcole]

Hi all,

I think there is a config option

Sketcher_3d_drag to No

which should disable the dynamic drag option.
It's a hidden option so you would not be able to see it or search for it but if you type it in correctly it will be added.

You can find the hidden 2001 options at the following website.

http://www.proesite.com/UTIL/2001_allopt.htm

Michael

 

[peppinu]

Thanks Michael

Do you by any chance know also the function of these hidden
config options?

PS. Can someone explain why on earth there are so many HIDDEN options which in the end are useful to know
and PTC do not tell you about them even if you beg them?


Joe Borg

http://www.methode-eur.com

 

[caruana]

Thanks alot.

:-D

 

[Akesson]

These hidden options is options that PTC is developing and not yet support or are 100% sure that the work perfectly yet.

 

[smeagol]

Hi all,

Does anyone know where I can find all the hidden config options for wildfire?

Thanks
Matt

 

[mjcole]

Thank you all for your responses it's good to know that you appreciate my post.

Matt,

You can also get the Wildfire options on Olaf Corten's Website that I listed for the 2001 options the address is the same except enter wildfire where the 2001 is in the previous listing.
--------------------------
Joe
I know that the ##_proj_depth and ##_proj_angle is for the new Extrude and Revolve dialog which has a windows explorer style tree similar to the analysis feature. These options also allow you to swith a feature from Thin to Solid which you may find useful.

Also
22_proj_hole on/off Turns off the new hole dialog box

Michael