NX 7.5 Drafting, Section depth. 1

[joncat]

I cut a section in drafting and would like it to only show say a depth of 36" from where I cut the section. I read that clipping planes will do this but I never get consistent results and it is a guessing game what numbers to enter. Solid Edge and Solid Works do this in a very simple fashion so I know it is possible. We deal with large complicated models and this ability would save us a great amount of time. Thanks for any help (NX7.5)

 

[JohnRBaker]

The distance to the Back Clipping Plane IS consistent, just that it's measured from the CENTER of the view, NOT from where the section is cut.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[joncat]

Thanks John, so back clipping is what I am looking for, how do I determine what number to enter to get a 36" view depth from where I cut my section in drafting. Sometimes I have models (like a bridge or a dam) hundreds of feet deep and will be cutting sections out of plane, and will never seem to figure where exactly the Center of the view is in relation to the section cut. Is there a section in the help, I looked into this years back on V18 and never did get it.

Thanks
Jon Cathey

 

[JohnRBaker]

Sorry, you just have to play it by eye...

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[joncat]

This is bad for us, we are spending hours cutting sections and playing with depth and sometimes never getting it right, if anyone could point me to a tututorial or help section that will help me understand how center of view and clipping planes work I would be most greatful, I'll also try GTAC again. Some of our guys are modeling in NX and exporting to SolidWorks just to be able to get the sections they need and using SW to draft. I want to get everything back into NX and this should not be so complicated. Am I missing something.

By the way John on another thread about ARRANGEMENTs you gave an example that will help us and save us tons of hours, thanks for all you contribute.

 

[joncat]

After reading everything I could find on cutting sections and not finding how to control depth easily, I called GTAC and asked about applying a depth to the section such that from the location of the cut, you would only see into the section say 36". My new friend Pat James at GTAC said he would investigate it and get back to me. An hour later here is the answer: Cut a section on a view,and place the View, the go back and select the Section Line and Right Mouse button and select Style... then change the Offset Value to desired depth from where the Section line is located, then Update the Drawing Views... Fantastic, I must have right clicked the view hundreds of times looking for a way to control depth, never thought to right click the Section Line. Anyway I wanted to share this because this will save us so many hours and I hope others will be able to use this tip.

 

[vrishraj]

Hi Joncat,
As per your procedure, unable to reproduce the same result. Please see the attachment file, using 2" offset value but no result. Any input on this will be appreciated.

Raj
NX 7.5

 

[RUGmechanic]

joncat,vrishraj

Me too, I am not able to reproduce the result. Tried a drawing/section view myself and your (vrishraj) part.
Maybe a setting in the customer defaults?

NX8.5 / Win32 XP

Older budweiser

 

[vrishraj]

Any update to this thread?

Raj
NX 7.5

 

[Toost]

The section offset is an old favorite of mine...
It will only hide OTHER bodies from the section view, it will not do a second cut through the model. ( It will not produce new edges.)
Open Vishraj's model, edit the second extrude feature and make it "Create" instead of "Unite". Then update the drawing.
I.e, it's of no use if you only have a single body.
Regards,
Tomas

 

[vrishraj]

Thanks Tomas,
Yes, I have checked as per your instructions and it works the way you explained. It shows the complete body which finds at that specified depth.

Raj
NX 7.5