NX6 - Drafting: Can you create two broken views from one view?

[Nougatti]

I'm drawing up a pipe-assembly, and two of the pipe sections are very long compared to the small, but interesting main part of the pipe-assembly (which the drawing focuses on).
I know I can use broken-view to "shorten" one of the pipe-sections so that it doesn't take up too much space on my drawing, but how can I do the same thing to the other pipe section when it is on the other side of the assembly?
As a substitute, I have tried using multiple detail-views from a smaller scale, but the drawing quickly became very cluttered and hard to understand.

I am Norwegian.
I design mechanicals for hydroelectric powerplants.
I use NX 6.0.5.3
----------------------------
Tom you can't knit at these speeds! Nobody can! DON'T BE A GODDAMNED HERO TOM!

 

[Toost]

A broken view cannot be parent of another broken view . Probably since the original view is part ( an area) in the broken view.
But, a broken view can have many areas. In the attached image there are 4 "areas" in 1 broken view.

Regards,
Tomas

 

[jerry1423]

You should be able to.
John Baker posted a video in this thread that should help you.

http://www.eng-tips.com/viewthread.cfm?qid=293418

 

[JohnRBaker]

The referenced thread with my video showing how to easily create the desired Broken View was done using NX 8.0. As stated in the last post of that thread, this is NOT possible without a lot of extra work when using NX 7.5 or earlier versions of NX.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[Nougatti]

Toost,

Do these areas have to be aligned in a straight line? If not, perhaps I can have three parts, where part 1 is the outermost part of the first way-too-long-pipe, part 2 is the main part where all the magic happens and part 3 is the outermost part of the second way-too-long-pipe?

-Nougatti

I am Norwegian.
I design mechanicals for hydroelectric powerplants.
I use NX 6.0.5.3
----------------------------
Tom you can't knit at these speeds! Nobody can! DON'T BE A GODDAMNED HERO TOM!

 

[Toost]

Good question, i have never tried to move them off center line.
But, i imagine that regular detail views might be a better choice if you want to move them around.
Can't you add a relatively small scale view showing everything somewhere on the sheet and then add a number of detail Views showing the interesting parts ?

Regards,
Tomas

 

[Nougatti]

As I wrote previously; As a substitute, I have tried using multiple detail-views from a smaller scale, but the drawing quickly became very cluttered and hard to understand.

Thanks for your help though! I'mma try experimenting with multiple-area-broken-views and see where that takes me

I am Norwegian.
I design mechanicals for hydroelectric powerplants.
I use NX 6.0.5.3
----------------------------
Tom you can't knit at these speeds! Nobody can! DON'T BE A GODDAMNED HERO TOM!

 

[Nougatti]

Found a solution!
I added three separate full views of the exact same assembly from the same angle and in the same scale, and then made partial broken-views in each of them. A broken view in NX only needs one closed loop (with spline), all though two (one for each end of the part you're "shortening") is the most common.
After bordering off what I wanted to show in each "piece"/view, I aligned them so that it looked like a proper broken view.

I am Norwegian.
I design mechanicals for hydroelectric powerplants.
I use NX 6.0.5.3
----------------------------
Tom you can't knit at these speeds! Nobody can! DON'T BE A GODDAMNED HERO TOM!

 

[Toost]

Good!
If this solution is ok, remember that you can copy/paste views instead of going through the "Add Base view".
The "only problem" with this method is if your assembly changes length dramatically, then suddenly one view can be empty.
You can then set an anchor on a point that always should stay visible in that view. ( Under View Boundary)

Regards,
Tomas