NX6 Sketches 1

[TomMtz]

Hi Friends

Let me comment something about NX6 Sketches, when I make one sketch (A) in a plane or face and I make other new sketch (B), the first sketch (A) hide when I stay working in the second sketch (B).

How can I get that the sketches are visible when I work in a new sketch?

I send one image about that.

Thanks for your help

Tom

 

[TomMtz]

I send Image


Tom

 

[jerry1423]

If your sketches are "internal" then make them "external" and I think it should work the way your want.
In the part naviator, rmc (right mouse click) on the feature that contains the sketch > make sketch external
Then when you are done with what you want it for then make the sketch internal again. If you associate something to that sketch then you may not be able to make it internal, which is not a big deal, but you have to live with it.

 

[TomMtz]

Jerry

I tried to apply your tip, in the part navigator but doesn't appear " make sketch external", only appears "Make current feature". And when I select this option many parts of the part navigator doesn't work.

Tom

 

[phillpd]

I think you're editing the sketch using the 'rollback' option.

Use the regular edit.

 

[TomMtz]

Phill

It happens using "regular edit" and "roolback".
But when I change the position of the sketches in the tree of part navigator I can "link" different sketches.
But I need to see all sketches without move in the part navigator.

Tom

 

[JonSelby]

Are the sketches being put on hidden layers? ... maybe try turning all your layers on?

 

[TomMtz]

Jon

All sketches are in active layers. probably I need to select a preference that permit show all active sketches.
In this time I finished my model, but I will try to find how resolve this item.

Thanks a lot for your comments.

Tom

 

[cadmantools]

When you are editing the first sketch you can set the sketch style to retain the dimensions. After finishing the sketch you can edit the next sketch and as long as the layer of the first sketch is selectable you will also see it.

NX6.0.4.3 mp02, Windows XP 32-bit
Running cad straight out of the box is OK but, a system tuned with application software is the best way to increase productivity.

 

[TomMtz]

Thanks for your tip, I will check it

Tom

 

[jackley]

If you are trying to edit Sketch A in regards to Sketch B, you won't be able to. Sketch A was created first, so Sketch B disappears. It makes Sketch A the displayed feature.

I am not sure on a work around from this.

Justin
Designer

 

[jackley]

Looks like I read your original post wrong. Scratch my previous post.

Justin
Designer

 

[TomMtz]

Justin

I am working considering that the previous sketch hide when I stay working in a new sketch, I only move the previous sketch in the part navigator to link sketches.

Thanks for your comments

tom

 

[man2007]

Can you upload the file? so that we can have better look at it. U can make save as, and delete all the features after Sketch B and upload.

 

[TomMtz]

Man2007

Attached file (.prt) if you edit sketch A you can see both sketches (A,B), but if you try to edit sketch B you will not see sketch A.
I think that using the file you can understand better this item.

Best regards

Tom

 

[cowski]

I think it goes back to phillpd's comment about edit with rollback. If you double click to edit the sketch you get edit with rollback, if you right click and choose 'edit' you will be able to see the other sketch but not reference it (because it comes later in the tree).

 

[TomMtz]

Cowski

I did not understand the first Phill's post, but now I have the answer. The problem was that I did not use "right click" to choose 'edit', all the time I used 'roll back'.

Thanks a lot for your comment, you are very professional

Best regards

Tom

 

[JohnRBaker]

From looking at your model it's obvious that what you've been told previously was in fact the issue. The ONLY way you will get the behavior that you describe is if you were using 'Edit with Rollback'. Perhaps if you understood better how 'Edit with Rollback' works it might help. Edit with Rollback, as the name implies, ROLLS you model back to the point at which that feature was created. By looking at the Part Navigator it's obvious that Sketch 'B' was created prior to Sketch 'A'. Therefore when you edit Sketch 'B' using Edit with Rollback, the system till take back to a point in time BEFORE Sketch 'A' even existed. Now if you're using double-click editing and you do NOT want to use Edit with Rollback you will need to go to...

Preferences -> Modeling -> Edit

...and change the 'Double-click Action' option from 'Edit with Rollback' to 'Edit Parameters'. Now when you double-click edit ANY feature you will go into simple 'Edit' mode with performing a Rollback (note that this will effect how ALL feature are edited, however starting with NX 7.5 you will be able to independently control the double-click edit behavior of Sketchers versus other Feature types).

Note that if you do not want to edit the double-click behavior, you will need to perform an explicit 'Edit' by selecting the Sketch, press MB3 and selecting the 'Edit' option.

John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

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