PMI dimensions not showing in Nx8.5 drafting 1

[gani009]

Hi,

I tried to use PMI dimension in drafting. When I call to drafting only I ma getting PMI notes. remainaing all are hidden or not showing. I created sample simple block. please find attachement and suggest me


Regards,
Gani

 

[SvenBom]

I have just done a test, and it works.

According to the pdf, you are selecting 'aligned to drawing (entire part)' option. NX Help documentation describes the following option as:
Displays all PMI objects in the part with annotation planes parallel to the drawing sheet when the view is added to the drawing.

Just with pdf, it is not possible to determine, what was the annotation plane for your PMI dimensions. Also, I don't see which standard view are you placing on the drawing. Let's say, that you are placing Isometric view. I am quite sure, that you did not define the datum plane for placing those PMIs. So, the annotation plane is almost sure not parallel to drawing sheet (looking at the Isometric view).

Before you are placing the PMIs, define the annotation plane.
For example, if you have the model oriented in the Isometric View, create a datum plane with 'View' option. Now, place your PMIs,oriented to this new plane. Now, when you are creating a drawing with Isometric view, you will have all the PMIs shown. Because your annotation plane is parallel to the drawing sheet,

But, here is better way of placing the PMIs.
First, activate the model view in which you want to place PMIs. I guess, that PMIs in Top view will not be shown in Right view. That way, you will have nice and clean model, where you get with model views just those PMIs, that are relevant for this model view.
And if you need some PMIs also in other views, you can simply copy/paste them to those views.

That way, you will also place the PMIs on the drawing much easier.

 

[gani009]

Hi Sven,
Thanks for your reply. I am getting PMI dimension when I place is standard views like Top and front. But my shopfloor wants those dimensions in isometric view so operators can undersatnd easily with 3D view. I tried as you specified but still I coudn't get that. I am attaching model. could you please check and correct me

Regards,
Gani

 

[SvenBom]

I guess that I have complicated my first answer to much.

First the solution.
You have placed your PMIs perfectly on your model. Dimension are oriented to proper views (top, front, right). You have copied those PMIs to the isometric view, which is also OK. Now, when you are creating a drawing, just place an Isometric view on your drawing sheet. But, instead of using 'Aligned to Drawing (Entire Part)', you have to use 'From Model View' option. And you will get all the PMIs on your drawing view.
In short, the steps for getting PMIs on a drawing were:
1. place PMIs on the model
2. copy the PMIs from all the views to the Isometric view
3. switch to Drafting
4. place the Isometric view with 'From Model View' option for PMIs

I have attached your model with PMIs in the drawing.

Now, about that parallel plane again.
I see, that you have created this plane. If the PMIs would be created in this plane, then those PMIs can be shown on the drawing with 'Aligned to Drawing (Entire Part)' option. These are the steps:
1. activate Isometric view in modeling
2. create datum plane with View option
3. select PMI dimension command.
4. in Selection Bar, select User Defined Annotation Plane and select previously defined plane.
5. now, place PMIs
6. when in drafting, you can now show all the PMIs with 'Aligned to Drawing (Entire Part)'
But, be carefull. Dimension placed like this are projected dimension. They are not showing the proper value. See the PMI, that I have placed.

 

[gani009]

Thank you very much now i got the solution